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Multibody sheetmetal cut list property to *.slddrw Sheet title.

Question asked by Roark Summerford on Aug 13, 2015
Latest reply on Dec 12, 2015 by Kevin Chandler

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Howdy,

I have been playing with Multibody parts with sheetmetal with a few solid parts here recently...

Anyway, I have a single part file. I have 6 items in the cut list.

In normal parts in an assembly world, I would open each part and go to custom properties and create a "Part name" and "Part number". All of my drawing templates know to populate the title block text boxes with linked values with that information. (If there is a better way to do that please let me know!) Makes doing lots of parts and large BOM assemblies very easy, especially when the file name is sometimes meaningless... I don't have PDM so changing file names can be a headache.

So in the cut list, I can add custom properties, works great for balloons in exploded part identification and assembly diagrams. It's just that I can't seem to select those custom properties for use in the sheet formats. What am I missing to be able to do that?

What would be great is... draw a mulitbody part with 1 configuration (I have cheated by using delete body and configurations to make a single part show up on a drawing but what a mess, and sometimes it gets lost and I end up with a folded part on a flat pattern view and other quarks of the like) in which I select a drawing view, select a single body, and boom... that drawing has that bodies cut list properties populating the title block.

Hopefully that makes sense and thanks for looking!

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Kevin Chandler Aug 25, 2015 8:27 PM
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Hello,

Have you tried "Relative to Model" views and then use select bodies to choose one multibody per view (& only one multibody per sheet)?

Cheers,

Kevin
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- Roark Summerford @ Kevin Chandler on Aug 26, 2015 11:48 AM
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  I've tried all of the radio buttons... is there somewhere else that says "Relative to Model" and yes, I have been using select bodies to choose one multibody per sheet. For whatever reason I can't get the cut list properties to be active in the "Edit Sheet Format". Thanks for looking!
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  - Kevin Chandler @ Roark Summerford on Aug 27, 2015 12:56 PM
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    Hello,
    
    I drew up a multibody sheet metal part and its drawing.
    There are 2 bodies, each on its own sheet, created using "Relative View" and its "selected bodies" option.
    
    In the part file, I added "CUSTOMPROP" as a custom property to each body in the cut list, set to it "111" for one body and "222" for the other.
    You can see these values displayed in the leadered note on each sheet.
    
    They're linked to the cut list but you can't get to them via the "usual" dialog box, you have to type the code directly.
    This means you must know what the secret sauce is, so here it is:
    Type in the note text field, $PRPWLD:"propname" with "propname" being the actual name you've created.
    You must include the quotes I've shown and as soon as you type the second quote, the property's value automatically replaces the secret sauce you just typed.
    $PRPWLD: is the code for all cut list properties (sheet metal or weldments) and it automatically reflects the value for the associated body.
    
    So, for the attached, I typed (for both sheets) $PRPWLD:"CUSTOMPROP"
    
    You can copy and paste the note and it will update to the value of the body in the selected view (if you didn't preselect a view before pasting, you can Attach to View after pasting).
    
    I hope this helps with you post.
    
    Cheers,
    
    Kevin
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    MB-SM.zip219.3 KB
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    - Roark Summerford @ Kevin Chandler on Aug 28, 2015 11:29 AM
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      Thanks... I was able to do that. I was wanting to get $PRPWLD:"CUSTOMPROP" in the sheet format title block... but it doesn't work in the sheet format mode I'm guessing because it cant recognize what it's attached to, not being associated to a drawing view. Which is a bummer, because it does it for normal parts all day long.
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      - Kevin Chandler @ Roark Summerford on Aug 28, 2015 12:40 PM
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        Hello,
        
        I tried a few ways too, but without success.
        The only avenue I see is to float the property text on the Sheet instead of in the Sheet Format.
        
        Also, as an aside, you can create a custom property in your templates that uses the secret sauce.
        That way you can give it a familiar name and be able to select it via the "usual" dialog box (and not have to remember the code).
        
        Note: The secret sauce won't evaluate in the properties dialog, it will just quote the code in the "Evaluated value" column.
        Don't worry about, just ignore this. The code will work the same as a custom property just as if you typed the code directly into the note.
        See attached.
        
        Cheers,
        
        Kevin
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        SecretSauceAsCustomProperty.JPG40.8 KB
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        Roark Summerford @ Kevin Chandler on Dec 3, 2015 12:49 PM
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        Kevin, I still haven't had any luck getting the a weldment cut list property into the sheet format. BUT... Big thanks for the introduction to "relative view". I only just realized how amazing that is for multibody parts... which I have a bad habit of making a lot of.
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Bernie Daraz Aug 28, 2015 8:46 PM
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Another Custom Property / Cut List question
Might be worth a look at that thread.
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- Daen Hendrickson @ Bernie Daraz on Aug 31, 2015 11:45 AM
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  Browsing the forum - interesting topic. Hey, Bernie is always showing good stuff; I'll follow his link.
  
  The biggest surprise was that I didn't know I used to know that... Thanks Bernie - for confirming I "can't remember $#!+".
  
  Daen
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  - Bernie Daraz @ Daen Hendrickson on Aug 31, 2015 1:26 PM
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    Thomas Edison is known for not knowing his own phone number. I can admit I don't know it either.
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Roark Summerford Dec 12, 2015 8:47 AM
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Okay... let's change the question a bit.
So I have a multibody sheetmetal *.sldprt file. What is the best way to identify each sheetmetal body on a print?

What would you do?

At my company I have a part number 5100. 5100 is the complete weldment corresponding to the *.sldprt file. It is made up of cut list items 5100-1 thru 5100-25. How do I make a print for 5100-4 (for example) that the print clearly identifies it without manually inputting the names on each print... or hovering a cut list property note over the title block? Or Is that "good practice"?

Thanks!
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- Kevin Chandler @ Roark Summerford on Dec 12, 2015 4:21 PM
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  Hello,
  
  A few thoughts:
  You can create a drawing for each body using Relative View (selected bodies option).
  With the view linked to the body, it's specific cut list properties will be linkable to it w/o the possibility of using the values from other bodies.
  
  If you're using one drawing file for this, you may want to smash the sheet number & total sheet count properties so each sheet, which reflects one part, has the sheet count correct for that, "5100-4" is on sheet 1 of 1, not sheet 5 of 26 (the parent part being sheet one),
  Warning: Sheet numbering now becomes a manual edit and upkeep item.
  
  What about revisions?
  Do you want each body to have its own revision?
  If so, add a revision property for each body, so body changes are unique to the body and the parent.
  Or is every body's rev tied to the parent rev?
  
  You can also create one drawing file for each body, but SW squawks when there's more than one drawing file per. And you'll looss the right-click, easy access to the drawing from the part. Plus it's more files to track.
  
  Cheers,
  
  Kevin
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Multibody sheetmetal cut list property to *.slddrw Sheet title.

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