Attached is a simple section view through a plate. Why is the plate longer in the section view? You do not ADD the length of your jog to the section! The section view should have a break line were all jogs are. Drafting 101.
You can control display of section view by using either solid or construction lines to make sections.
To add to Mike's comment, you can create your section view nearly automatically by starting the section view command first. In SW2013, we removed the need for drawing a sketch to make a section view in most scenarios. By starting the section view command without a sketch, you will access the Section View Assist tool, which allows you to build your section views very quickly, again, without having to drawing a sketch. The scenario in your example would be very easy and quickly made using Section View Assist.
I'm sorry, but the length of a jog should never in the section view.
Nice quick response, hey?
Jody, there are several 2D methods that are applied to section views from the ASME and ISO standards (and also drafting tradition) which do not take into account 3D models at all. 3D CAD software creates actual cuts on the model, which often create situations where section views are more accurate, but not displayed in a method expected by many users. One of those methods are Aligned sections. Aligned sections do total up the length of your individual segments. Another method is the display of ribs where some features remain uncut even though they are actually being cut by the cutting line.
Customers have requested all sorts of scenarios, even mixed cases. Some users who learn how to draft in one method or by one set of rules may not be aware of other common practices or even the standards themselves. SOLIDWORKS tries to accomodate as many scenarios and expectations as possible. Conflicting ideas by different types of customers have to be addressed in many cases. We make sure we follow the standards as closely as possible, but also work hard to cover user expectations when the users do not use the standards.
In the case of Section views, the Section View Assist tool covers a wide range of use cases with very easy cutting line generation. If you wish to generate the cutting line by drawing your own sketch, the rule for jogs is that you'll simply need to set them as construction lines to tell SOLIDWORKS that those are the ones you wish to treat as jogs. However, if you use Section View assist for most (almost all) cases, you'll never need to create your own sketch. Forcing a user to create a sketch so that they can create a drawing view isn't the best user interface anyway. Why take the user out of the mode of projecting views by forcing them draw a sketch? However, if you do have one of those unusual cases where you need to take a more direct control over the interpretation of your cutting line, SOLIDWORKS still ofters you that ability.
The arrows on the section line represent line of sight, which is why you only jog parallel to the arrows. I'm old school. You would never add the length of a jog to a section if you where on a drawing board. Also, the jogs should not be drawn as object lines in the section view, they should be broken lines, look it up.
Here is what I found that nobody mentioned.
1) Sketch your jogged section line.
2) CTL Select each line you just drew..yes one at a time grrrr... and hope SW doesn't select the centerline you have directly under your section line.
3)Select the Section view icon.
4) A window pops up and you select "Create legacy ...etc.
No argument. Just answering your question and providing information about the functionality.
The legacy method in your image is not recommended unless you have a specific case where it is needed, particularly non-orthographic bends in cutting lines where results will be foreshortened in a direction not normal to the cutting line segment. For most cases (especially those that you describe), simply start the Section tool (without drawing a sketch) and the place the cutting line on your parent view and use Section View Assist to add your jogs. You'll be able to create section views with jogs with Section View Assist much quicker than drawing an initial sketch first. The more jogs you have, the more time you'll save over sketching.
Edit: Is there something about the user interface of the Section tool that brings you back to preferring to work with sketches to create your section view?
I do not see any in the Secion View Assist option in the Section view dialog box.
I need to add more jogs to an existing section line. How do I get back to the Section View Assist tool?
I believe if you just edit sketch and change the sketch to add the jogs it should work fine.
Yep you can probably do it that way, but Matt turned me on to this cool sectioning tool and I want to know how to get back into it. It's way easier then editing a sketch.
Jody, if you have SW2014+, you can RMB on the cutting line and select Edit Cutting Line. The offset tool pop up reappears, so you can add new jogs. The only caveat is that the cutting line had to be created in SW2014 or newer, and on a cutting line that has not had it's sketch edited directly yet.
I don't see anything that says Edit Cutting Line. See attachment.
I don't see anything that says Edit Cutting Line. See attachment. Ooops. forgot the attachment.
2014 SOLIDWORKS Help - Creating a Section View Manually
Not sure what version of Solidworks you have but I believe it depends on how you create your section view. Solidworks gives options to include the cut faces and the jog faces, elongating the view, as well as doing it a more standard way and showing just the section cut and not the jogs also. Check how you created it.
Look at 2014 SOLIDWORKS Help - Creating a Section View Manually. Appears to be due to using a construction line over a solid line in the sketch.
Hope that helps
edit: Just noticed Mike got in first
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