I would like to know if there is a way to add text to section line letters to reflect zone and page numbers. I try to add the text but it just dissappears.
Can you tell us a little more about what you are doing? Give some more detail of the steps you are taking, perhaps we can help figure out why it is disappearing. Is it possible for you to attach your file or a screen capture?
(select advanced editor to the top right of the reply edit window to attach a file)
I double click on the text and begin typing . When I am done, the text will dissapear, I place the sh 6 now as an independent text in the view, but if the section line moves the sh # needs adjusted independently. I used to use inventor and you could add text to the callout and it would move with the section line. It is part of the requirement for the job I am working on. Other jobs require the zone number as well.
Step 1) Add note with leader attached to the section view and place the note close to section arrows.
Step 2) Now select the notes that was added and select no leader.
Step 3) Now when you move the views the notes also follow the view.
I tried this. it will work for now but it only moveds with the view, not the section line and arrow.
-Make a new layer and call it what you want.
-Activate this layer and edit the sketch for your Section Line
-Add a point near the top and bottom of your line and dimension them to where you think the bottom left corner of your text would be. For Instance SH 6. Bottom left under S. This is a variable you will have to play with to fine tune so just guess and move on for now. Top and bottom should have the same two dimensions.
-Activate your normal layer for text, probably called text
-Create the text note "SH 6"-Activate your layer you created at the beginning
-Draw a box around "SH 6" and touch the sides closely of the letters mainly focusing on the bottom and left portion of the box to touch close.-Highlight SH 6 and the box only and make a block.-Under the block options expand "insertion point"
-Drag and drop the triad and other point to the bottom corner of your rectangle
(The block is automatically saved to this drawing but you can save this out to reference later for other drawings)
-Now under your feature tree you have a blocks folder.-Drag and drop your block ( left click the block and hold while dragging to your sheet and release) and the insertion point will snap to the point you made at the beginning once you are close.
-Open up the layer properties options and click the light bulb for the layer you created for the box and point to hide it from view and printing.-For the dimensions for the points click "hide show annotations" then click the 4 dimensions then click "high show annotations again" (The dimensions will always be there for fine tuning the location of your SH 6.)
The only problem is if you explode the block it will not follow the line anymore. So if you need a SH 6 block and a SH 7 block you will have to explode one to be able to have two. It's not a big deal since you can just snap the block back in and explode it.
I hope this isn't too confusing. Reply if so.
Retrieving data ...