Is it possible to get my part configuration to display as follows in a bill of materials?
filename (space) configuration name
Thanks in advance for your suggestions.
You can set the configuration BOM property to user specified and then add the required values "Manually". You'll have to update this value every time you make changes to file name or configuration. There is a macro in case you want to use this method.
Second way is to add three properties. One for file name, one for configuration name and finally third which concatenates both of these one property with value as $PRP:"SW-File Name" $PRP:"SW-Configuration Name" and use that to display in the BOM
Perfect, thanks, Deepak!
My company for matters of "consistency" wants me to relocate the configuration name of one of our parts (base part with many, many variations in length). The configuration name is technically the part number for the part length, but the file names (which is where most almost all of our part numbers are derived) do not match the part numbers on these components.
In the attached image you can see that we have very simple assemblies (typically 3 or 4 components), but can have high instance counts. in this case the actual part name & file names for Items #1 & #2 are as shown (W5G...). Item #3 however is an assembly I created to represent a one-piece complex stamped component. It is a formed metal support channel of which I modeled the stamped end. This I attached two instances of to either end of an extruded "U" component that I vary the length of for final overall assembly length. This assembly filename is the (1.250 INV RIB...). The specific length configuration is the part # for a specific single component.
I have been making my BOMs like this for more than 10 years. Or I should say I have been using SW built-in BOM functionality to inert them. ALL length variable components are shown as I have them here. In the last two weeks they have decided for consistency they want the configuration of part #3 (technically the actual part # used in the drawing) to be in the cell where the file name is shown. They want this so the part #s are consistently shown in one column. They just now noticed the BOM is arranged this way by SW.
Using Deepaks method I can insert the $PRP:"SW-Configuration Name" in the part number cell to force the text to display what I want, but now I am looking at them requesting potentially this manual edit on every drawing we produce or revise. As the only CAD operator in the company over the last 10 years I have a pretty good idea how many drawings they will end up being... ALL OF THEM. If I do this won't the BOM links then be broken, thus opening ourselves to costly errors if the cells aren't "consistently" and manually updated if an assembly is changed?
I know you can control the displayed data through the column properties. That is to change the display of the entire column though. Is there any other of automated way of making this change?
You could create a property in the configurations which would combine/concatenate these properties and label them as part number. And then you can use them in the BOM. This would keep the BOM linked.
And you can update all configurations via a macro OR even task scheduler (not fully sure on TS).
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