I'm trying to build new wheel pants for our Bonneville Streamliner.
SurfaceCut5 seems to get suppressed when I Unsuppress the Flat-pattern18 feature.
I need the dxf of the wheel well half for the waterjetting.
Try to do this as a surface first. Extrude surface and trim to get shape. Then thicken it and convert to sheet metal by using insert bends option.
I got to the point converting it to sheet metal but I must be doing something wrong.
Can't get it to convert.
1. Delete everythig tha lies under Surface-Offset1 except Sketch7
2. Make Surface-Offset1 visible and hide rest.
3. Adjust diameter in Sketch7 to show tthe outer diameter of wheel well.
4. Make extruded surface from Sketch7 up to Surface-Offset1.
5. Thicken result. Choose correct direction.
6. Choose edge shown on screeshot and use Insert Bend. Hit OK.
7. Hit Flatten........
Unless there is a reason that's not apparent to me, you can skip converting to sheet metal and just use a Base Flange to create the piece as sheet in one step. See my example in the post below.
I find sheet metal parts almost always work best if you can make them as sheet metal from the start. I save thickening surfaces, shelling solids, etc. with convert to sheet metal for situations that really require it.
command circled in black
The surface cut is apparently too complicated for sheet metal flattening, not a normal cut. I changed the swept flange to a base-flange extruded up to the surface, and switched from using Bend Allowance to K-factor and the part flattens nicely. See if this will work for you. On a radius this big the K-factor value is probably OK at .5 but you might want to tweak it if you have necessary forming info.
Thanks Erik! That worked perfectly!
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