I am trying to wrap this hex sketch to the surface of a dome When i select the sketch and wrap, it gives me a partial, convoluted result. What is wrong? Thanks for the help!
It is not a warp feature, but the result is similar in this case. When you create warp feature, SW strighten selected face, gets the sketch and again warp the face. During warp, the face with the sketch is streched to mach original face. So this is the reason you have this result.
will this work
Yes, I had thought of this, but I needed the wrap feature where the extrusion or cut is tangent to the surface at that point.
You are not supposed to be able to wrap onto spherical surfaces, so I'm surprised the wrap even executed at all.
I just did a extrude from surface
I was talking about the original file.
This is what I am looking for. Can you explain how you did this?
Your polygons are axisymetric. So I used your sketch to create another with only 2 polygons. Based on new sketch I created revolved surface to get intersection with parabolic face (split face feature). In the center I created separate split feature because revolved surface created wrong result. Based on split faces I copied 3 surfaces and used them to thicken surface. Thicken feature adds material prependicular to the parabolic surface. I assume that this result you wanted to get from warp feature. At the end I created circular pattern.
Yes, that works well. If I wanted to extrude the split feature through the material instead of thickening it, what would I need to do?
Thanks for your help
By this I mean cut through the material
You could thicken in the opposite direction, then do a Combine/Subtract feature.
Even better, there is a cut thicken feature. Great idea.
Oh yeah I forgot about that.
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