AnsweredAssumed Answered

Deform Surface to Surface

Question asked by Christian Carlsen on Sep 11, 2014
Latest reply on Sep 13, 2014 by Christian Carlsen

Like • Show 0 Likes0
Comment • 12

I have a solid square structure that i want to deform to take the shape after another tool solid. I have tried using the Surface push feature, with no luck, it's only approximately the same, not completly.

How can it be done else? I dont want to use the indent or intersect feature, because the solid structure has different layers in it, and i want these layers wrapped around the tool surface.

The curve-to-curve deform feature doesn't work either, the solid is not tangent between the guide curves.

Best regards

Christian

Paul Cullen Sep 12, 2014 8:33 PM

Correct Answer

Hi Christian

I have never used the deform surface feature before but this is what I did

First I hid your surface body and only showed your sketch. I then edited your sketch and selected all the lines and arcs and used the fit spline command to convert the sketch into a continous spline.

I then created a sketch on the opposite large face and using the convert entities tool I made a copy of my spline.

I now used the deform tool to deform the solid body, I used the curve to curve option and I selected the outside edge and the first sketch

Then I selected the + to the right of Set to add a second set of selections , make sure and slide the accuracy slider to the right

Select ok and your part then looks like this

Hope this helps. If you only wanted the top piece of your part to deform them maybe you could split the body into 2 pieces then deform the top part and then do an extrude to join the 2 pieces together again.

Hope this helps

See the reply in context

No one else had this question

Outcomes

Jesse Robbers Sep 11, 2014 10:50 AM

I'm unsure of what exactly you're wanting as others may be as well. Please post a picture or file to help us visualize your intent. maybe replace face or copy body then combine (subtract) feature.

Actions

Christian Carlsen @ Jesse Robbers on Sep 11, 2014 11:24 AM

Yes of course.

I have made an example, the left picture is before i use deformed shape, and the right is after. The upper solid bodie is what i use as tool/curvature solid, as per second picture. As you can see, i does not follow the exact curvature of the tool solid. I need the sharp corners, that it seems to smooth out. And i cant turn the Deform Deviation to 0 either, 0.38mm is the smallest number i go.

Best regards

Christian

Actions

Eric Irwin @ Christian Carlsen on Sep 11, 2014 3:02 PM

Christian,

This should be possible with the "Replace Face" command. I believe you will have to be sure that you pick the surface body, not just a face of the surface body. You may have to use the "Select Other" option to get the body.

You could also do an extrusion with the "Up to Surface" option for the depth. I know for sure that will let you pick the surface body, not just an individual face.

Actions

Jamil Snead @ Christian Carlsen on Sep 11, 2014 3:06 PM

I probably don't understand what you are trying to do, but can you just make the part longer and use an Extruded Cut to chop off the top in that shape?

Actions

Lenny Bucholz @ Christian Carlsen on Sep 11, 2014 6:09 PM

there is many ways to get what want, deform is not one of them.

extrude the shape from the side view of the top surface you are trying to use to deform, then add the holes.

or try the deform before the holes

or put up the file so we can see how you've modeled the part.

or, or, or

Actions

Paul Cullen @ Christian Carlsen on Sep 12, 2014 8:33 PM

Hi Christian

I have never used the deform surface feature before but this is what I did

First I hid your surface body and only showed your sketch. I then edited your sketch and selected all the lines and arcs and used the fit spline command to convert the sketch into a continous spline.

I then created a sketch on the opposite large face and using the convert entities tool I made a copy of my spline.

I now used the deform tool to deform the solid body, I used the curve to curve option and I selected the outside edge and the first sketch

Then I selected the + to the right of Set to add a second set of selections , make sure and slide the accuracy slider to the right

Select ok and your part then looks like this

Hope this helps

Actions

Paul Cullen @ Paul Cullen on Sep 13, 2014 4:30 AM

Ok I have played around with this some more and here is what I have got. I think it is better than what I have shown above

You will see from the picture that I have shown the surface extrude and that I have made it red

I then created a sketch on the top surface of your body and converted the outline of the 3 holes, I then used this sketch to do a surface trim so as to cut the projected outline of the 3 holes into the surface body

I now used the deform tool to deform the part, I used the same curve to curve option but instead of selecting edges to sketches , I select an edge of the body and then the corrosponding edge on the surface above it. I then selected the bottom face as the fixed face

I now have the deformed part but as you can see in the picture below the top face of the body and the original surface are not the same, they intersect each other

I then used the replace face feature to replace the top face of the body with a face matching the surface extrude

As I said I have not used the feature before but from playing around with the settings this is the best I could do. Maybe somebody has a better way of doing this using different tools

Hope this helps

Paul Cullen

Actions

Christian Carlsen @ Paul Cullen on Sep 13, 2014 8:28 AM

This worked for me now, thank you very much everybody for the help!

Actions

Christian Carlsen Sep 12, 2014 5:05 PM

The original structure is very advanced and big, (0.5 Gb), so i can't opload that, but i will upload this I made earlier.

I can't cut it after extrude because of the layered structure. I have to deform the original structure in some way.

Solidworks_deformed_shape.sldprt - Speedy Share - upload your files here

As i said, this file is only a example, and to show what i want to do, have a solid structure with many different layers wrapped around a "tool structure"

I'm no expert in solidworks, but i'm definitely no novice.

Best Regards

Christian

Actions

Jamil Snead @ Christian Carlsen on Sep 12, 2014 5:24 PM

I don't know exactly what you mean by layers, but is there any reason you can't just model it in the deformed position? See my attached file.

Attachments

Solidworks_deformed_shape JS.sldprt.zip219.8 KB

Actions

Lenny Bucholz @ Christian Carlsen on Sep 12, 2014 7:36 PM

Is Jamil's the way you want it to look?

he did it the same way I would, so.....

why is it you want to use the deform?

because you just don't want to remodel it or move this before that in the tree and fix any errors that might happen?

some more info may explain to us the thought process of what you want to accomplish.

Actions

Tom dunn Sep 12, 2014 8:26 AM

Can you make the top surface a solid part and use the combine tool with subtraction?

Attachments

example-td.SLDPRT.zip71.7 KB

Actions

12 Replies

Jesse Robbers Sep 11, 2014 10:50 AM
Mark Correct
Correct Answer
I'm unsure of what exactly you're wanting as others may be as well. Please post a picture or file to help us visualize your intent. maybe replace face or copy body then combine (subtract) feature.
Like • Show 0 Likes0
Actions
- Christian Carlsen @ Jesse Robbers on Sep 11, 2014 11:24 AM
  Mark Correct
  Correct Answer
  Yes of course.
  I have made an example, the left picture is before i use deformed shape, and the right is after. The upper solid bodie is what i use as tool/curvature solid, as per second picture. As you can see, i does not follow the exact curvature of the tool solid. I need the sharp corners, that it seems to smooth out. And i cant turn the Deform Deviation to 0 either, 0.38mm is the smallest number i go.
  
  Best regards
  Christian
  Like • Show 0 Likes0
  Actions
  - Eric Irwin @ Christian Carlsen on Sep 11, 2014 3:02 PM
    Mark Correct
    Correct Answer
    Christian,
    
    This should be possible with the "Replace Face" command. I believe you will have to be sure that you pick the surface body, not just a face of the surface body. You may have to use the "Select Other" option to get the body.
    
    You could also do an extrusion with the "Up to Surface" option for the depth. I know for sure that will let you pick the surface body, not just an individual face.
    Like • Show 1 Like1
    Actions
  - Jamil Snead @ Christian Carlsen on Sep 11, 2014 3:06 PM
    Mark Correct
    Correct Answer
    I probably don't understand what you are trying to do, but can you just make the part longer and use an Extruded Cut to chop off the top in that shape?
    Like • Show 0 Likes0
    Actions
  - Lenny Bucholz @ Christian Carlsen on Sep 11, 2014 6:09 PM
    Mark Correct
    Correct Answer
    there is many ways to get what want, deform is not one of them.
    
    extrude the shape from the side view of the top surface you are trying to use to deform, then add the holes.
    
    or try the deform before the holes
    
    or put up the file so we can see how you've modeled the part.
    
    or, or, or
    Like • Show 0 Likes0
    Actions
  - Paul Cullen @ Christian Carlsen on Sep 12, 2014 8:33 PM
    Unmark Correct
    Correct Answer
    Hi Christian
    
    I have never used the deform surface feature before but this is what I did
    
    First I hid your surface body and only showed your sketch. I then edited your sketch and selected all the lines and arcs and used the fit spline command to convert the sketch into a continous spline.
    
    I then created a sketch on the opposite large face and using the convert entities tool I made a copy of my spline.
    
    I now used the deform tool to deform the solid body, I used the curve to curve option and I selected the outside edge and the first sketch
    
    Then I selected the + to the right of Set to add a second set of selections , make sure and slide the accuracy slider to the right
    
    Select ok and your part then looks like this
    
    Hope this helps. If you only wanted the top piece of your part to deform them maybe you could split the body into 2 pieces then deform the top part and then do an extrude to join the 2 pieces together again.
    
    Hope this helps
    Like • Show 0 Likes0
    Actions
    - Paul Cullen @ Paul Cullen on Sep 13, 2014 4:30 AM
      Mark Correct
      Correct Answer
      Ok I have played around with this some more and here is what I have got. I think it is better than what I have shown above
      
      You will see from the picture that I have shown the surface extrude and that I have made it red
      
      I then created a sketch on the top surface of your body and converted the outline of the 3 holes, I then used this sketch to do a surface trim so as to cut the projected outline of the 3 holes into the surface body
      
      I now used the deform tool to deform the part, I used the same curve to curve option but instead of selecting edges to sketches , I select an edge of the body and then the corrosponding edge on the surface above it. I then selected the bottom face as the fixed face
      
      I now have the deformed part but as you can see in the picture below the top face of the body and the original surface are not the same, they intersect each other
      
      I then used the replace face feature to replace the top face of the body with a face matching the surface extrude
      
      As I said I have not used the feature before but from playing around with the settings this is the best I could do. Maybe somebody has a better way of doing this using different tools
      
      Hope this helps
      Paul Cullen
      Like • Show 0 Likes0
      Actions
    - Christian Carlsen @ Paul Cullen on Sep 13, 2014 8:28 AM
      Mark Correct
      Correct Answer
      This worked for me now, thank you very much everybody for the help!
      Like • Show 0 Likes0
      Actions
Christian Carlsen Sep 12, 2014 5:05 PM
Mark Correct
Correct Answer
The original structure is very advanced and big, (0.5 Gb), so i can't opload that, but i will upload this I made earlier.
I can't cut it after extrude because of the layered structure. I have to deform the original structure in some way.
Solidworks_deformed_shape.sldprt - Speedy Share - upload your files here

As i said, this file is only a example, and to show what i want to do, have a solid structure with many different layers wrapped around a "tool structure"
I'm no expert in solidworks, but i'm definitely no novice.

Best Regards
Christian
Like • Show 0 Likes0
Actions
- Jamil Snead @ Christian Carlsen on Sep 12, 2014 5:24 PM
  Mark Correct
  Correct Answer
  I don't know exactly what you mean by layers, but is there any reason you can't just model it in the deformed position? See my attached file.
  Attachments
  - Solidworks_deformed_shape JS.sldprt.zip219.8 KB
  Like • Show 0 Likes0
  Actions
- Lenny Bucholz @ Christian Carlsen on Sep 12, 2014 7:36 PM
  Mark Correct
  Correct Answer
  Is Jamil's the way you want it to look?
  
  he did it the same way I would, so.....
  
  why is it you want to use the deform?
  
  because you just don't want to remodel it or move this before that in the tree and fix any errors that might happen?
  
  some more info may explain to us the thought process of what you want to accomplish.
  Like • Show 0 Likes0
  Actions
Tom dunn Sep 12, 2014 8:26 AM
Mark Correct
Correct Answer
Can you make the top surface a solid part and use the combine tool with subtraction?
Attachments
- example-td.SLDPRT.zip71.7 KB
Like • Show 0 Likes0
Actions

Deform Surface to Surface

Outcomes

Attachments

Attachments

Related Content

Recommended Content