Most of time, the same part will be insert to multi times in the same assembly as different component, how I can mark or indicate them to distinguish them easily in assembly tree or graphic window.
such as give some mark or the description to the name on the assembly tree, or create some note on the graphic windows.
Some ones can tell me how I can do that, how many ways I can achieve that?
Thanks in advanced.
Are you saying that the same SLDPRT is used in an SLDASM but using different configurations?
If so, you can have the configuration name (and display state) showing in the Feature manager Tree of the assembly.
This is controlled in the configurations properties area of the SLDPRT.
The red box is where the configuration and display state are shown.
Hope this helps...
Thanks all, Folder and configuration function are good for me. Except that, can I change the component name (without changing part name) in the assembly tree, or add some description or suffix to the component.
Because some times, the same part will assembled to different position as many components, they shows in the same status (No need part configuration), in order to manager them easily, I hope that I can make some special mark for each of them.
Such as below:
Part_A <1> (Use to....)
Part_B <2> (This part need to..)
And if there is one way to indicate them on the graphic window, that will be better, especially the hug assembly.
I'm not sure if you can actually rename individual instances of a part within an assembly. What you could do is create a folder for each component and name the folders Part_A (Location 1), Part_A (Location 2), etc.
Also if you want help identifying them in the graphics area you could assign a unique color to each instance, and even put that color in the folder name, for instance Part_A (Location 1, Yellow)
Also if you are having trouble finding the component in a large assembly you can use the isolate function (right click on part in tree and select isolate).
Hi Li,
Please go to System Options - External References and uncheck 'Update component names when documents are replaced'.
Then select Part in FM tree and choose 'Component Properties' > type new string in 'Component Name:' field.
Now, you will see this new name in FM tree (for that part instance only) without renaming the part.
Thanks,
Adrian ILIE
Hi,
You can create a folder in feature manager design tree by selecting selective parts and make as a group, to differentiate other parts in assembly. Kindly refer below screen shot.
Regards,
Yuvaraj S