You will probably have a better chance of getting an answer if you move this to the SolidWorks Simulation/Simulation forum, using the button in the Actions box to the upper right. Some of the folks there may have Abaqus experience.
I will try that out, thank you for the tip!
probably best to take this to the 3ds swym forums
I got to know the solution for the problem I had.
An Elbow section cannot be specified in /CAE. That’s why do so: specify the beam as a pipe-section in /CAE. Then you have to write out the inp-file from /CAE using:
Job -> Write input
Then you get a inp-file that you can edit like:
** Two, or more, asterix give a comment line.
***Beam Section, elset=_PickedSet2, material=steel, temperature=GRADIENTS, section=PIPE
*Beam Section, elset=_PickedSet2, material=steel, temperature=GRADIENTS, section=elbow
Data line 1
Data line 2
Where according to the Abaqus 6.11 keyword manual *Beam section:
Data lines for ELBOW sections:
1. Outside radius of the pipe, r.
2. Pipe wall thickness, t.
3. Elbow torus radius, R, measured to the pipe axis. For a straight pipe, set .
This value is not written for the Pipe-section so it have to be added.
Enter the coordinates of the point of intersection of the tangents to the straight pipe segments
adjoining the elbow, or, if this section is associated with straight pipes, the coordinates of a
point off the pipe axis. The second cross-sectional axis will lie in the plane thus defined, with
its positive direction pointing toward this off-axis point.
1. First coordinate of the point.
2. Second coordinate of the point.
3. Third coordinate of the point.
( Also use:
*Preprint, echo=NO, model=YES, history=YES, contact=NO
So that you can look in the dat-file that all detailed input that is written there is what you specified. )
After you have made these change save the inp-file under a new name and then run Abaqus using: