this is the Top view of my part (iso view shown so you know what it looks like).... why are there lines missing!?!?
I have approved driver and I even cranked the "wireframe and high quality HLR/HLV resolution" with little change......any ideas?
Are tangent edges visible turned on?
yes... but it's the outside of the part edges are even missing.
It does seem this is related to the System Options settings for 'tangent edges'. Please note there is a 'tangent edge' setting for models and a setting for drawing views, and these can be managed seperately.
The setting for models is found at System Options > Display/Selection > "Part/Assembly tanget edge display". Options include: As visible; As phantom; or Removed. Selecting the 'Removed' setting generally provides a clean graphic image of the model, as it seems to be in your example model.
The settings for drawing views is found at System Options > Drawings > Display Style > "Tangent edges in new views". Options include: Visible; Use font; or Removed. Selecting the 'Visible' setting will allow the tangent edges to be seen on new drawing views. Note however that changing this setting will not update any existing views, only those that are new. Therefore, some drawing view recreation may be necessary to get the desired tangent edge results. (Please see next comment - thanks JF for the correction!)
right clicking on the view will accesses the tangent edge display options for that view - no recreation should be needed.
Great, but it isn't tangent edges. They are sharp corners. Here is the same part with the teeth suppressed:
and here is two screen shots of the same view with the teeth... I just went in the Doc Properties and cranked the image quality for Wireframe all the way down and all the way up and got different results:
I'm going with this is a bug and I'm submitting to my VAR, but I'm still up for suggestions.
Try going to actual model file and setting the image quality to the much higher or to the max. I've see weird things that for some reason were fixed when this was set higher (It's really rare but worth a try I suppose).
Hadn't thought of changing the model file settings for the drawing. But it didn't change anything.
You wouldn't by any chance be able to post the model would you?
I can post the model with some dimensional changes but still having the problem.
In the drawing, is the view set to draft quality?
Have you tried to export/import then create a drawing to see if it is a SW2013 part problem?
I'm off subscription so I can't check the SPR, but since going to SW2013 I've had a similar issue with drawing views that are brought in as "Hidden Lines Showing". I can switch the Display Style to "Hidden Lines Removed" and that fixes it. Then I can switch back to "Hidden Lines Showing" if needed and it's still OK. I don't know if it's the same for you, but I thought I would mention it.
The SPR is pretty specific for my case I guess... "Lofted cuts that overlap themselves are not showing all lines in drawing views", which basically came from my VAR being able to reproduce with a simple cut loft that "rolled-over" on itself in one view orentation. I'm not so sure this is the true "root cause" but at this point I'll just move on because the number of times I'll have the issue here will be very small.
SW did have a workaround as to use a surface loft and then do a surface cut, but I didn't try that one yet
Anyway, I've tried all the switching from HLR, HLV, Wireframe, Shaded w/ Edges, Shaded w/o Edges and it never fixes it. Oh well, back to work.
I don't know if this is a proper work around but accidentally I have found something weird,
When I was detailing a weldment, tangent edges were set to hidden and display style was set to hidden lines removed
STILL SOME EDGES WERE MISSING WHICH ARE NOT TANGENT AND MUST BE VISIBLE OTHERWISE.
1- Click empty space on the view
2- Click Hide/show edges
3- Hover over your mouse on the edge which is not behaving the way it should
4- Edge will be highlighted in orange
5- Click once (Nothing will happen)
6- Click twice (edge will be displayed)
7- keep mouse position excact
Hope it works,
I have tried it accidently
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