OK, I have the equation box open. But I cannot delte any of the "Global Variable"
Because, "Cannot delete parameter name. The parameter is in use by some other dimension" warning.
So how do I break these equations?
is there a red "infinity" symbol in front of the dims you are editing? that is teh symbol for "linked" dimensions. right-click on one of them and choose "unlink dimension".
There is an Edit All button in the Relations Editor Dialog.
If you hit that you'll see all the Equations written out. SolidWorks requires " " marks around the dimension names this allows for spaces to be used instead of the endless "_" underscores Required by Pro/E.
The Linked Values are better than the Pro/E functionality because there is no left hand right hand side relation. Either Dimension can be changed and all the linked values will maintain the same value.
If the dimensions are Linked via an Equation, SolidWorks will Tell you this Dimension is driven by an equation and cannot be changed or something to that effect.
Unlike Pro/E SolidWorks dimension numbers are per feature so your model may have tens of D1 dimensions. you can have
"D1@Sketch 1", "D1@Sketch 2" , "D1@Sketch 3" which in Pro/E might be D1, D24 and D50.
Regular Relations or (Constraints) as called in ProE can be shown or hidden via View > Sketch Relations (suggested hotkey Shift+R) but SolidWorks cannot yet hide Dimmensions with an icon like on ProE. I put in an enhancement request for that. The SolidWorks Relations can be suppressed to disable them but they can be managed by configurations.
If you don't like the Sketch Expert you can tell solidworks to Make Overdefining Dimensions Driven by default to keep your screen from getting too colorful
That was the silver bullet I was looking for.
Thanks to everyone else who tried to help on this one.
I should've metioned that what Solidworks calls Relations, Pro/E calls Constraints and what Pro/E call Relations, Solidworks calls Equations.