Is there a way to enable highlight selection when you are in large assembly mode? In large assembly mode, when I hover my cursor over a surface or edge, nothing displays but if I select the surface it will select.
Is the box "Do not display edges in shaded mode" under System Options/Assemblies/Large Assemblies selected? What happens if you unselect it?
Nothing changes if I uncheck that box.
Any other ideas??
Run the Rx tool to see what it reports.
Turn on the Use Software OpenGL option. If the problem goes away, delete all graphics drivers and re-install the approved driver for your system.
This is not a graphic issue. To test this, set your option to open assembly in large assembly mode for 50 or more parts and open any assembly that has more than 50 components. Now you will be in Large Assembly mode. Try to select some surface or edges and the highlight preview does now work. It will let you select but it does not let you pre select your selection.
Mukesh, that is by design.
When Large Assembly Mode is on, the following options become unavailable (grayed out) on their respective System Options page or toolbar, and are automatically set as described below. When Large Assembly Mode is turned off, the options return to their previous settings.
System Options pageorToolbar
Status whenLarge Assembly Mode is on
Show contents while dragging drawing view
Off. Only the view boundary is shown while dragging a drawing view.
Smooth dynamic motion of drawing views
Off. Dynamic operations to drawings, such as panning and zooming, do not display smoothly.
Automatically hide components on view creation
On. Any components of an assembly not visible in a new drawing view are hidden and listed on the Hide/Show Components tab of the Drawing View Properties dialog box.
Drawings - Display Style
Display style for new views
Hidden lines removed is set as the default display style for new views.
Display quality for new views
Draft quality. Only minimum model information is loaded into memory. Some edges may appear to be missing, and print quality may be slightly degraded.
Dynamic highlight from graphics view
Off. Model faces, edges, and vertices are not highlighted when you move the pointer over a sketch, model, or drawing.
Off. Jagged edges in Shaded With Edges, Wireframe, Hidden Lines Removed, and Hidden Lines Visible modes are not smoothed out.
Assembly transparency for in context edit
Maintain assembly transparency. Components not being edited retain their individual transparency settings.
Off. The geometry in the graphics area (edges, faces, planes, axes, and so on) is not highlighted when the pointer passes over the item in the FeatureManager design tree.
High quality for normal view mode. While the part or assembly is not moving or rotating, the transparency is high quality. When moved or rotated with the pan or rotate tools, the application switches to low-quality transparency, enabling you to rotate the model faster.
Only on demand. Initial curvature display is slower, but uses less memory.
Level of detail
Minimum. The level of detail is minimal during dynamic view operations (zoom, pan, and rotate) in assemblies, multi-body parts, and draft views in drawings.
Check out-of-date lightweight components
Don't Check. Loads assemblies without checking for out-of-date lightweight components.
Update mass properties while saving document
Off. Does not recalculate the mass properties on save. The next time you access the mass properties, the system will need to recalculate them.
View toolbar and menu
Shadows in Shaded Mode
Thanks Alin but this is not good design. We should have the option to set the preview in large assembly mode as we wish.
Mukesh, I hope you know that you can open an assembly in large assembly mode, after which you can turn the LAM off and on at will.
Yes, I know that but I want to use all the Large Assembly features but at the same time have the option to also allow preview on edges/surfaces while in LAM.
I agree with you. Please submit an ER and let us know the SPR number once you get it. I will vote for it!
In SW2005 you can configure large assembly mode to have highlighting
or not. This is one of the most missing features that kept us using SW2005.
It is very dissappointing to request ER's for things things that worked well
in the past.
It needs so many unnecessairy mouseclicks and with modern hardware there
is no reason to switch highlighting off in large assembly mode.
Every Cad program has highlighting, I think Autocad 2.6 already had this since
in 1987. Why has Solidworks discontinued this very usefull function in 2006 and
never fixed it? It doesn't make much sense to add a lot of fancy features while
the basic more important Cad functionality is just getting broken and never fixed
Another very dissapointing regression that is now an ER is the following problem:
We always use standard parts (that can have hundreds configurations, like bolts
bearing, etc etc) to have the last used configuration, so we can give it a name like
87-bearing.sldprt and in every subassembly where this 87-bearing.sldprt is used it
has the last saved configuration. This was an option at least in SW2005 and it was
one of the most powerfull options to work with standard parts.
We build machines from standard parts that have a lot of configurations and this
works very fast when you can use last saved configuration.
But what happened, after 2007 this option was not available anymore!
While I sended in an SPR request I got a message back that I had to sent in an
Suppose we have used this bearing in 40 subassemblies but we want to change
the configuration name from 6003 to 6004, so the bearing needs to change from
15 to 20 mm.
Before 2007 this was one click in the part 87-bearing.sldprt and change the config
and every other subassembly automatically updated to the correct size.
After 2007 this same mouseclick to change 40 standard parts in 40 subassemblies
needs me to search 40 times in 40 subassemblies and change every single part.
This really drives us nuts and has kept us from upgrading almost 10 years now.
We still buy upgrades sometimes to test but we still don't use it, these problems
cause us more timeloss than all the new fancy features that don't save as much
time as these regressions that now need ER's.
I just checked 2014 and highlighting still does not work in large assembly mode.
Apart from that, when using dimensions flat to screen selecting dimensions seems
like a trial on error operation, needing about 3-5 times more mouseclicks before
you get the dimension to edit. When in large assembly mode it with highlighting off
it is even more work. I suppose this is just a bug, I hope this doesn't need to sent
in an enhance request !
Please fix the problem with highlight and last used configuration
Why should you break something when it was a user configurable option in first instance?
Apart from these problems, the performance of 2014 when compared to 2013 is improved!
But still not upto the level of SW2005 with the same hardware. Selecting (missing highlighting),
editing parts and working with standard parts in large assemblies is so much faster in SW2005.
The fancy features don't make up for the regressions.
We design complex machinery for the food industry like custom designed vision controlled
pick and place units and robotics.
I know it sounds strange that using such an old version is faster than the latest release but
it really is and we have carefully explored all the new functions almost every year.
Only because of some regressions that never get fixed and now are ER requests.
I have been using SW since 1995 and at some point things got bad.
On the performance side I am a bit more possitive!
I had this same problem until I realised that opening an assembly as lightweight (using the open-dialog box) will give a responsive model with the mouse-over visual effects that you need. This worked for me, maybe it works for you too?
Retrieving data ...