Is this correct?
Sketch with points in part A.
Sketch with points in part B. Click on sketch in A and then convert entities???
It works if I show sketch A, click on a point and convert it.
If I click on Sketch from the feature tree and convert it won't work.
However clicking on the individual sketch entities in the graphics area will convert.
Just ran into this problem today. There is an easy solution using the 'Save Selection' feature...
*) Exit from any sketch you may be in.
*) Enable 'Filter Sketch Points'.
*) Window or lasso select all of the points you wish to convert.
*) Once all of the Sketch Points are highlighted, right-click anywhere and select 'Save Selection' from the menu.
*) SolidWorks will save this info in a folder in the Feature Manager called 'Selection Sets'.
*) Turn off Selection Filter.
*) De-select the old sketch or you will edit it by mistake.
*) Begin new 2D or 3D Sketch.
*) Select 'Convert Entities'.
*) In the Feature Manager, expand the Selection Set and select the first Sketch Point in the list.
*) Scroll to the last point and Shift-Select to capture all points in the list.
*) The Feature Manager will begin to populate with the Sketch Points. (Be patient. May take a while.).
*) Once the Sketch Points are in the Feature Manager, select the green check-mark to finish.
*) Exit the sketch.
That should do the trick.
Note that this technique can be used to convert 3D Points to 3D Points or 3D Points to 2D Points.
The best part of course is that the new Sketch Points remain associative to the old.
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