I am new to Solidworks Routing. I want to add a pipe without any fittings to a 12inch header at 45deg. Help me in this regard.
I have attached a picture which can give you an idea of my question.
Thanks in advance.
Draw the 3 lines in a separate sketch (not in the route sketch) then add a plane normal to 1 of the lines. Edit the route and add point at each line using the point and plane.
Or you can create a ghost fitting part (a disc perhaps) with the route diameters you use and place it in the end of each of the three lines. This must have exclude from BOM option enabled because you wont need it to appear in the BOM
I would do what George has suggested. We actually have a configured part that only contains a sketched circle with a CPoint (I call it "Dummy Route Point" but it's actually a dummy connection point). The configurations represent all of the different pipe diameters (see attachment).
First step - draw a construction line in an existing plane (XZ plane below) that's perpendicular to the main route. Then draw a line at an angle, make it perpendicular to the main route (important), and some angle (45°) from the construction line.
Second step - drag in the "Dummy/Ghost Route Point" from the design library, drop it on the end point of the angled line and select the pipe size from the configuration window. The pipe should show up (image below).
Third step (optional) - Right-click the point where the main route and angled pipe line intersect and choose "Penetrate." This will make a nice clean "saddled" connection between the angled pipe and the main route.
I also attached the "Ghost Connection Point" part that we use to do this. Note that you may want to select the part in the FMT and click "exclude from bill of materials" in the properties dialog. Otherwise you might have purchasing people asking you where to buy a "Dummy Route Point"
Hope this helps,
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