Hi,
When fixing a failed surface and its modifications after, I’m unable to repair through Edit>Surface –Trim feature. At the Edit window I’m unable to pick “Keep/Remove selections”. Only way is to delete the feature and re-do it!
Why is it?
Hi,
When fixing a failed surface and its modifications after, I’m unable to repair through Edit>Surface –Trim feature. At the Edit window I’m unable to pick “Keep/Remove selections”. Only way is to delete the feature and re-do it!
Why is it?
This happens all the time.
You could check with any surfacing part you have.
Attached is just an example assembly I did.
In the Part1 there are 2 surfaces
In the Part 2 there is an offset of one of the surfaces of the Part1 and some surfacing functions and Surface-Trim feature.
Now in the Part2 edit the Surface-offset feature and select the other surface in the Part1
Then try to edit and fix the errors!
it is working for me
Strange,
I'm unable to pick the face!
Just tried it in 2012 and it works like a charm, both in the part file or in the context of the assembly.
Let me try also in 2011 SP5.0. Yup it works in 2011 also.
Michael, do you have a certified videocard (and driver)?
Message was edited by: Alin Vargatu
Hi Alin,
Not in my SWx2011, I could remember tis issue in earier versions too.
VideoCard:
Hi Michael,
I also don't have any problems with doing this as you can see in the pic below. Of course I am using Logopress3 along with SolidWorks and I am using SolidWorks 2011.
I think that the problem is as Alin suspected, with your non-certified graphics card. In Logopress3 support, as I'm sure Alin sees with SolidWorks support, we see a fair amount of these GeForce cards causing strange problems like this. If you aren't in a position to change to a great card like an NVIDIA Quardo 4000, you could always simply go on eBay and purchase an inexpensive, used but certified older card to test with.
Best regards,
Ray Proeber
Are you all sure that you didn’t manually re-picked the surface in “Trim Tool” ?(which appears automatically if you follow my steps!)
If I first edit Surface-Trim with the other surface as the “Trim Tool” and then edit the Surface-offset and later tried again Surface-Trim by re-attaching the new “Trim Tool” surface, then it is working as you show.
Hi Michael,
I'm not 100% certain I'm following your exact steps.
Are these the exact steps that should duplicate your problem?
Best regards,
Ray Proeber
Following is from our VAR? Are they using non-certified video cards?
CASE 100645: Unable to repair through Edit>Surface -Trim feature
Hello Michael,
Thanks for the additional information and the sample file.
I found that when following the process you described, I also could not select the area to keep/remove, until I cleared the "Trim tool" box and re-selected the Surface-Offset1 feature.
Once I had re-selected the feature I could select the area to Keep or Remove. (see attached image)
Please try clearing the selection and re-selecting the trim tool. If this does not resolve the issue please let us know.
Hi Michael,
I am pretty sure that your VAR is not using non-certified cards, or of course they would not have asked you if you were.
So it appears that I was not following the exact same steps as you were or your var was, because I didn’t see the problem you described. (See the forum post I just posted)
So if you can carefully outline each step I should try, one at a time, I would like to try to duplicate this.
But of course, please be aware that if this particular thing is not related to a non-certified card, there are other things that are caused by non-certified drivers. We’ve seen in firsthand with other customers.
Best regards,
Ray
Think as you got a new reference surface!
I think you missed this first step:
Okay Michael, now I can reproduce it after you provided the detailed steps above. Thank you.
Note that anytime you are not sure if a problem is related to SolidWorks itself or any add-in software you are using, simply uncheck the add-in software and try to duplicate it. If it is still an issue you know it is not related to the add-in.
Please mark this question as answered if you agree that it has been answered.
I think everybody missed the main step of this issue! Isn't it?
Sorry Michael, I got it now. I was able to replicate the behaviour you described.
I believe there might be a quasi-logical answer for it.
If you edit the Surface-Trim1 you will see that the trimming tool is called: Surface-Offset1@Part2-1@Assem1. Well, while that assembly name looks nice and grand and kind of correct, it does not really exist at the part level.
See the attached pictures, before and after re-selecting the trimming tool:
Wondering if this is a bug or a limitation. I will find out and let you know.
SPR 631359 (After a surface trim tool created in context is edited, it's not possible to select the part of a surface to keep or remove)
I see your are in rollback, try it without rollback and then see what happens?
you really have given us enough to go buy. having the file helps us play and see if we can fix.