one of the parts in my assembly is in roll back mode, and therefore I can do anything with the assembly. However, I don't know which part it is. How can I see which part is in roll back mode with out opening every part in the assembly?
Did SW just randomly give you an error that one of your parts was in a rolled back state and now you cannot do anything in the Assembly or any other files you have open? I have had SW do that to me recently and I wasn't even able to close the program normally, I had to end the process in the Task Manager and I know that none of the parts I was working with were rolled back because it was not that large of an assembly.
so far I can not find a file that is rolled back. I have been browsing some of the other posts, and it seems like this has been an on going problem.
Anyone have any new solutions?
Just for kicks, what happens if you call up the assembly and do a pack and go of it.
Then call up that new assembly. Will it still be in roll back mode?
well its too late, I just did an end task and restarted SW. However, when I re-opened the assembly, there was no prompt about any files in the roll back state. This seems to show that there were actually no parts that were rolled back.
Well, the bottom line is you got it resolved and that is what counts.
You should get a prompt saying something like "There are part(s) in rolled back stage, do you want to roll them forward" and when you click Yes, it should fix the part.
Also there is macro some where that can fix the parts which are rolled back.
I am pretty sure this is just a bug. There are no parts rolled back, it just locks up your system so that you have to shut down SolidWorks and lose any unsaved work.
I recently had the same issue in an assembly with 2000 parts. many of the parts will be in use by up to 27 other designers in another state (Iowa vs. Nebraska). I did see that message after dumping works, rebooting, and re-loading. All was fine after that cycle that costs me 30 min.
We just ran into a case where that message popped up. The scenario was caused by being inside a sketch in a part and while in that sketch, access the custom properties. You don't necessarily have to change a property, just open them and close them. Then when going back to the assy, it tells you that a part is in rollback. To prove that's the part, go back to it, pull the bar up and then push it back to the bottom. Then the assy likes it.
Just ran into this same error. Tried your method of pulling the bar up and pushing it back to the bottom and it cleared up the issue.
Previously the work around I was using to avoid losing work was that I could still get to "File-Save and Check In..." on the menus and would click that, give it a bit to complete the save and cancel it once it started the check in process.
Got this response from our VAR just now:
"The behavior that you described to an existing bug report SPR 259045 "'One of the components of this assembly is in rollback state. The assembly is inaccessible now.' after editing a part and switching to assembly". The suggested workaround for the behavior "'Drag the roll bar up (past at least one feature) and then back to the bottom, after editing the part'." has already been implemented and seems to have resolved the behavior for the time being."
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