Can anyone help with this??
I am working with an imported .IGES file converted from Pro-E (Wildfire 5.0). I have been trying to run the FeatureWorks Tool to define most of the features, and I'm running it 'Interactive' rather than 'Automatic' because I was not getting the results I wanted.
I was successful at recognizing a few Holes and Cut Extrudes, but I am having major trouble with the Fillets and Slotted cut-outs. (see attached photos)
It is an oddly shaped part and all of the edges are filleted. I have tried to use the 'Cut Extrude' feature to recognize the Slots, but no luck...
Does anyone have any suggestions??
Thank you!
Regards,
Hillary
Hillary, with featureworks, I've found the best way to work the part is in reverse machining order: slots and holes, rounds and chamfers, drafts,ribs, small cuts and bosses, large, cuts and bosses
This is especially important in your case because your fillets are breaking across a face at an odd angle.
If you can't get a face to recognize, then maybe try telling feature works to delete it and add it manually yourself after you've finished recognizing the part.
I've had pretty good luck with Featureworks, but there have been situations where it simply couldn't cope with the design intent that I was trying to establish.
You've got to think of featureworks as a bag of tricks instead of a deterministic path to a goal.
In these cases, where I can't get the whole model to recognize what I find helpful is to:
save a copy of the part,
use the delete faces function in featureworks to simplifiy the part,
recognize the simplified version.
insert the copy as a derived part,
create sketch based features that reproduce the ones I couldn't recognize (use convert entities to get exact measurements)
delete the external relationships
add dimensions to fully define the new sketches
then delete the derived part feature.
Hope that helps.
John