Is there any way to pattern components at a given spacing along a sketch radius?
Is there any way to pattern components at a given spacing along a sketch radius?
Can you post something to show what you are trying to do.
You could do a sketch driven pattern, where you split the radius into the amount of instances you are looking for then constrain the radius sections with equal lengths and the two ends equal to each other and dimension the arcs with arc dimensions.
I'm trying to pattern the post and blockout along the radius (in sketch 8 in the soil and rail Part) at 75" spacing.
Can I do a sketch driven pattern in an Assembly?
Not sure if this is the best way to do this, but it works!
I patterned a hole in the rail in the 10 percent grade part. Then used a feature driven pattern in the assembly, the driving feature being the patterned hole.
This is how I would do it also.
What I discribed before is for a part and not an assembly
Very Nice Mike.
I was going on that there was not a direct command to accomplish this. Probably should be.
When I looked at your model, I kind of see what you did. I am not that familiar with 3D sketch,
but I didn't see how you got the posts to follow the curve. Editing the patterns I think I was expecting
to see some kind of guide curve, but patterns don't allow for that. So what is getting the pattern to curve like that?
The pattern in the assembly is driven by the pattern in the part. The pattern in the part was created by a 'curve driven pattern'. I used the sketch that created the guard rail to drive the pattern for the holes.
I had a little trouble getting the posts to follow the curve (or turn along with it). In the pattern for the holes I did for the rail, I had to check the box in alignment method 'Tangent to Curve'. This made each hole turn as it went along the curve. Then I mated the first post in the pattern concentric with the hole in the rail. This caused all of the other posts to align with each hole.
He placed the hole on the rail in the Part, patterned it along the curve in the Part with a Curve Driven Pattern, then went back to the Assembly and the Feature Driven Component Pattern to pattern the posts and blockouts. I never would have figured it out on my own, having never used either of those commands before.
That worked. Thank you, I couldn't figure out how to do that without a bringing in all of the parts and mating them seperately. That would have taken a lot more time than I want to spend on this.
Thank you for your explaination. That makes sense.
Nice post!!
Not sure if this is the best way to do this, but it works!
I patterned a hole in the rail in the 10 percent grade part. Then used a feature driven pattern in the assembly, the driving feature being the patterned hole.