I have a part that is all advanced surfacing and I am trying to make a config file (simplified rep in pro-e) and I can't get it to work right and I am using 2010. Can someone give me some guidence on this ?
Are you having a problem creating the config, or with changing the sizes of the model after the config is created?
I am having problems creating it. Is there a step by step process you can help me with ?
What are the steps or process you following to make the configs? Are you getting any error message? Can you post the part in case one can check that.
ok.. that's where I have been going. I create a new config, then I pick the surfaces I want in the model tree that is posted in the main display screen, click the check mark for done and then I activate the new config and it doesn't show,
When your in the properties menu, shouldn't you be able to select from there ?
You succesfully create a config ... so now you have a Default config and the newly created config (ncc)
The ncc is automatically activated after it is created
You enter the main Feature Manager, select faces and then select the green check mark
What are you expecting to happen at this point?
I want to see my model without the trim surfaces. What I'm trying to do is a scanner handle and I have trim surfaces that are in my way, so in pro, I would do a simplified rep to take those trim surfaces and hide them, if you will, that's what I want to see with this. I want to see my base model, without all the trim surfaces.
If you only want to hide them, you don't need a configuration. At the top of the tree is a folder for "Surface Bodies" just right click and hide them all. Or expand the folder and hide/unhide them individually.
You can also create a display state, at the bottom of the configuration window. Unlink it from the configuration....then create one for just showing the model, then another for showing all the construction surfaces.
I know about the surface bodies folder. In all reality, I don't want to keep hiding them. I want a version without those surfaces on it, hiding was just for a lack of better term. Can I config file do what I'm asking ? As a new Solidworks user, I may be asking the software to do something it can't do, or is a config file in solidworks like a family table in Pro-E ?
Do you still want the features intact? You could create a “Delete Body” feature and delete all the surface bodies. They are still there though if you suppress the delete body feature.
You could insert the part into another part and only bring over the model solid body. There are no features but its linked back to the original file.
Configurations are just like family of parts….you vary dimensions, suppress/unsuppress features to create alternate versions of parts. What are you trying to do……you don’t want the surfaces to be there at all? They are needed for the features to rebuild that rely on those surfaces I guess I’m not sure why you want them gone.
I don't want to delete them, I just want to suppress them. I need them to trim up my model later down the road, but becasue I'm working on the handle section right now, there in the way. I just want a different version with those trim surfaces suppressed, so I only have the body and the handle curves. I thought I could do it with a config file, it soumds like I can ?
This is a confusing piece of SW terminology.
Deleting a surface body from the Surface Bodies folder effectively suppresses the surfaces from the point the Delete Body feature is created. It does not actually delete the surfaces from the model.
yes, alternate configurations of a part can have different features suppressed.
if you have not used the surfaces yet, I would hide them (with or without using the display states as mentioned) and then show them when you are ready to use them.
if you are done using them, but they are still in your way, use the delete surface body and they will be gone unless you roll-back before the delete, or suppress the delete.
I'm sure what you need is very simple thing to achieve but yes there is some confusion going on. Can you post a sample file of what you have and what you need. OR some pictures.
I can post it this afternoon
In the new configuration, go to the surface bodies folder, select all the surface bodies you don't want to see, and hit delete. From the pull down menus, insert>features>delete bodies will get you the same results.
You may have to go back to your default config and suppress the delete bodies feature so the surface bodies aren't deleted in this config.
You know.. I think this is what I was looking for
Retrieving data ...