Brian Graves wrote:
Place a single hole wizard hole on one of those existing sketch points and then use a sketch driven pattern to duplicate that hole wizard hole across all of the existing sketch points.
I can't remember if this method creates the correct hole callout quantity...
It doesn't.
SPR 995681 - Add ability to read instance count for Sketch driven pattern and able to show them in Hole callout when patterning hole wizard holes
Brian Graves wrote:
Place a single hole wizard hole on one of those existing sketch points and then use a sketch driven pattern to duplicate that hole wizard hole across all of the existing sketch points.
I can't remember if this method creates the correct hole callout quantity...
Perhaps try editing the hole wizard placement sketch and then click on the external hole placement point sketch and click convert entities. will bring the entire sketch over.
It does not create the correct hole callout quantity (at least as of SW 2018 Sp5):
sketch driven patterns of holes don't show hole count in drawing
Edit: and Jim Sculley beat me to it.
For the Reasons Jim and Dan have mentioned, I never use hole patterns with hole wizard holes.
After you have an extrusion created that you want to put hole wizard holes in you should make a sketch (or use the original sketch for that extrude) and place and dimension POINTS on that sketch.
When you are ready to add your holes, set that sketch with the points to "SHOW".
(this can be done after you have made other extrudes or cuts or added other features)
Open hole wizard - Select your hole type/size/settings.
Select the Positions tab as you normally would to place holes.
Move the cursor to the face you want the hole to start on (as you normally would when adding a hole (do not click on one of the points at this time). this should be the same face your points are on.(you can also use the 3d Sketch option if you have points on multiple sides of the extrusion).
Move cursor Near but not over one of the points that you previously placed on the surface/part. (all you position dimensioning should be done on the Original Sketch) (you can have undimensioned points in the previous sketch and go back later and dimension. re-dimension or delete them later if you want) . You can also go back and add more points later on the original sketch but you will have to edit the hole positions to add the hole you want to that point.
When close to the point where you want the hole, Left mouse click and hold down - do not release.
Move the cursor over one of the points and you will see the dot highlite as well as the hole diameter (as shown below). you may also see the Coincident indicator show (but it may be under your mouse cursor icon).
Selected
Not Selected (if no Orange dot the position is not yet selected)
Without moving off the point, release the Left Mouse Button.
Your hole indicator will show as below.
Repeat this process of selecting each point you want that hole type on
Multiple holes can be selected before exiting the hole placement process:
When done, click the green check mark 
to exit the placement process and your holes will be placed.
To edit the hole positions go back to the original sketch where the points were placed and adjust the positions / dimension or delete if you need.
to add more holes, go back to the original sketch and add more points and then edit the Hole Wizard hold and select the newly added points.
You can also have all the points for all hole types on the same or other sketches and select the ones you want to use for different hole types.
Rick, this is exactly what I didn't want. I want the result to be one sketch bound to the hole wizard feature. Not two sketches, one external driving the internal hole wizard sketch.
I'm starting to think a simple copy all and past may be the best solution. Copy from the original sketch, past in hole wizard sketch. Recreate any missing dimensions in the hole wizard sketch that did not copy. Then, delete the original sketch.
I guess I was looking for some type of convert sketch to hole wizard sketch tool. In other words, when you create the hole wizard feature, instead of creating a new sketch, tell it to use an existing sketch similar to what cut and extrude features do.
Then I'm not getting what you want. It is one sketch controlling the holes - not 2 sketches.
You are just showing what sketch points that a hole will use instead of creating a new hole pattern sketch in the Hole Wizard.
This method I showed can either be a sketch that defines an extrusion with the hole points on it
OR you could make an independant sketch on a part/surface/feature that would be dedicated to those Hole Wizard holes.
It could be used as a master sketch for holes of one size/type or for multiple holes of different sizes/types.
When you do the locating of the Hole Wizard hole points on the previously defined sketch points, those become the Hole Wizard location points. You change the point location the hole follows, you delete the point the hole goes away. The benefit is you can have one sketch with dimensions as a master sketch of sorts that you can control as sketch points. You can have individual sketches for individual hole types or you could combine holes on one (or more) sketches.
I am using 2015 but if I change the number of holes my drawing does update correctly indicating the number of holes I have placed (providing the holes and not out in space off the extrude)
I suggest Convert Entities, delete references using external filter under Sketch Relations. Dimension it again. Delete old sketch.
Hello,
I just turn on (Show) the original sketch and use the point filter to select the points.
You can also create a derived sketch to get the plane onto a plane not parallel to the original sketch (and use point filter).
Yes, it's technically another sketch, but it's driven by the original.
The downside, which I think goes to the OP, is that HW doesn't use the original points and that you can't broadly select them (not even Ctrl+A) as they doesn't reside in the HW sketch.
Therefore you must clicky, clicky, clicky.
Kevin
Thanks, everyone for your feedback.
I ended up using select all in the original sketch. And pasted it into the new sketch. All dims contained in the sketch were copied. I only had to replace the positional dims that referenced geometry outside the original sketch. Then deleted my original sketch.
Place a single hole wizard hole on one of those existing sketch points and then use a sketch driven pattern to duplicate that hole wizard hole across all of the existing sketch points.
I can't remember if this method creates the correct hole callout quantity...
Perhaps try editing the hole wizard placement sketch and then click on the external hole placement point sketch and click convert entities. will bring the entire sketch over.