I want to insert over twenty pins into a assembly. How do I insert more than one at a time?
are they same pin 20times, or 20different ones? will they be mated in places later?
If they are the same part then just click the little 'pin' icon at the top of the selection box and you can insert as many of the items as you want and still mate them individually in their respective locations.
Yes you can do that. I would suggest to check the component pattern option.
In case you want the part in different orientation, then you can dissolve the pattern and all instance would be independent.
You can also create mate references in the mate which would speed up applying mates.
Assuming you will need them mated...
Insert one pin and mate it.
1) use a pattern to get the rest
2) Use Copy with Mates
twenty of the same pins inserted into the assembly at once however I don't wont them patterned
Kahasim Brown wrote: twenty of the same pins inserted into the assembly at once however I don't wont them patterned
Kahasim Brown wrote:
If that is the case, I prefer the copy with mates as Rick mentioned.
where is copy with mates located?
Kahasim Brown wrote: where is copy with mates located?
Right click on the item you desire to copy.
Alternately you can go to insert > component > copy with mates (at the bottom)
A trick if you are unable to locate a command is to type the command in the search bar. Then as the options show below you can hover over the eyeball to the right of the command and it will show you where to find it in the drop downs.
Thanks for help so this will insert all the components and mates from the original base part?
How do I fully define the sketch or find the relations that make it under-defined?
The way this works it that you place and mate the first pin using mates that can be repeated for each of the following pins. Like a concentric to the hole and a distance from the end of the pin to the face the pin is inserted into. Next select the pin and "copy with mates". you will have a dash board that pops up which gives you the choice of mates you desire to copy. if the pins are all into the same surface you would only need to select the hole it goes into and let the surface remain the same. If the pins are on different planes you would need to select both mates. Now you select the hole and surface for the second pin, then the ok green check and the pin is placed. repeat for each pin you have.
Jim Steinmeyer wrote:... Next select the pin and "copy with mates". you will have a dash board that pops up which gives you the choice of mates you desire to copy...
Jim Steinmeyer wrote:
... Next select the pin and "copy with mates". you will have a dash board that pops up which gives you the choice of mates you desire to copy...
Click on the arrow to see the mates for the part you selected...
Thank you Rick
How do you select ok instead of the check mark to go to the next copy you want to make without selecting the mates and components all over again?
Kahasim Brown wrote: How do you select ok instead of the check mark to go to the next copy you want to make without selecting the mates and components all over again?
When you get to the mate screen on step 2 you have the option of selecting the repeat box. This box will use the same reference as the seed part. In the shot below I am copying a bolt so the flat of the head is mated to the plate surface and the neck of the bolt is concentric to the hole. If all of bolt holes are in the same plane I would check this box and would not need to select that mate. Since you are not using a pattern you will still need to select each hole you want a bolt in.
Another option would be to use the "profile center" mate and reduce the number of mates needed. You select the edge of the hole and a circular edge on the bolt then select profile center for the mate option. This will place the circles concentric and will mate the selected edges coincident however you are able to add an offset if you desire so you could set your pins extending out of the surface. I have never tried this one with copy with mates though. The biggest drawback I find with this one is that it needs complete circles so slots or plasma cut holes with lead-ins do not work.
It is a really confusing feature.
Select the check mark next to repeat for however many mates you would like to repeat.
make active the data input field for a new mate and select surface/edge/etc.
Select green check mark and another instance of the solid will be placed.
Repeat for additional parts.
When done select red X to end command.
2020 SOLIDWORKS Help - Copy with Mates PropertyManager
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