Do anyone have ever tried our SolidWorks CAM 4th and 5th axis Indexing? I would like to know fundamental procedures to be follow to define 4th and 5th Axis Indexing?
4 & 5 axis indexing works well and is fairly simple. To start, what machine do you have and what are you looking to accomplish. In the help tutorials, there is some information and examples on indexing but if you could provide some more insight to what you have to make the part on, it may help us point you in the right direction.
Also, do you have a custom post for the 3+2 process? Depending on the post settings, you may need to set up the part in CAD with a coordinate system so the index knows how to rotate correctly in the machine.
The last two years at SOLIDWORKS World, we use 3+2 machining on a UMC-750 and a Matsuura MX-330. I can say it is usually easier when programming in indexing to do it in Assembly mode and have the fixtures and tables modeled as parts. This allows you to check for clearances of the tooling and holder and you rotate and position the part for specific features.
You can program in part mode but it is harder to visualize the clearances.
I have created a quick video that shows the setup for a 4th axis sample using a Rotary on a mill. Please let us know what questions you have or what you need. This shows the basic setup in assembly mode using an SW coordinate system as the reference for rotation. This is how I program indexing in SOLIDWORKS CAM and have Programmed 4 and five-axis simultaneous parts using CAMWorks in the past.
I have gone through 4th axis Indexing machining in SW Assembly. But I have a trouble in basic understanding in Part level Indexing process. Herewith I have a shared one of the practice model for your reference. Kindly guide me on that. What are the basic steps defined in this model for achieving 4th axis Indexing.
Downloadable Link: https://drive.google.com/open?id=1rfWJYDUFmM6Q228SCVg73sbVyB1lQldv
This is the model from the training manual correct? The setup for indexing in part mode is similar to assembly mode. You start at the definition of the machine and define the index of 4 or 5 axis and the rotation and tilt.
Once you have defined the number of indexing required, 4 or 5 axis. you specific rotation and or tilt
Once the machine is defined with the correct movements, you program the part using Mill part setups interactively or through AFR. The Mill part setup is what establishes the rotation or tilt based on the machine definition above.
In the Mill part set up on the operations tab, you will see that SW CAM automatically captures an index angle based on the zero planes in the machine setup you spec'd at the beginning. These index positions are what gets output in the g-code when you post process.
From the programming standpoint, you define the machine and where zero is set for rotation and tilt. Next, you program the part as you would typically within SOLIDWORKS CAM. The system will automatically capture rotation and tilt planes for output to the G-Code. It can be overwritten if you want, but by default, it works well for indexing assuming the post-processor is created with the correct rotation and tilt calculations. These calculations are all built on geometry, which is why SW CAM shows both plane values above in the index setup. Depending on the machine you have, you may be able to tilt 70 degrees one way vs. 110 another. Through the post processor, we may need to tell the machine to rotate the table and tilt to the opposite plane vs. just tilting the table. This is due to the requirements set up in the machine definition in SW CAM and the post processor working together.
Please let me know if you have any questions.
I've been using Solidworks Cam for a lot of 3+2 Simple parts for my customers. Do you have any tips and tricks to properly set up an assembly for machining?, What does your work flow look like?.
There are a number of ways I have seen people do this in SW CAM/CAMWorks over the years. What works best for me is to know the origin for tilt and rotation in relation to my fixtures and machined components. When we set up the Matsuura at SOLIDWORKS World this year, the assembly looked like this in SW.
The critical place we started was to make sure the table and rotation we correctly referenced in SW. This allowed us to use the tilted working planes in the machine for offsets and calculation as the part rotates.
This also allowed for easy export to verification software after the part was programmed. For SWW we also used CAMplete for tilt and rotate verification. By having the coordinate system and table digitally captured, the import into CAMplete was automatic and the verification was simple.
As you can see below the tilt and rotate are close to the center of the vise we used. Creating this digitally makes it easy to visualize, program and validate before cutting.
Those are my 2 cents anyway.
Have a great day!
Retrieving data ...