Is there a way to tell what kind of structural shape a cut-list item is or barring that, that it is a structural shape vs a part made without using weldment profile, such as a plate? In the Cut-list feature, it shows a special folder icon for structural shapes and regular folder icon for stuff created without using weldment profiles so I am hoping it is possible. See attached for an image of the folders in cut-list.
Thanks in Advance,
Chris
Solidworks 2018
Hi Chris, you could use the profile path to figure out the shape. The feature name also defaults to the shape as well. Use this code to traverse all features but only return information about the weldment structural shapes.
Option Explicit
Dim swApp As SldWorks.SldWorks
Dim swPartDoc As SldWorks.ModelDoc2
Dim swFeature As SldWorks.Feature
Dim featureName As String
Dim message As String
Dim tName As String
Sub main()
Set swApp = Application.SldWorks
Set swPartDoc = swApp.ActiveDoc
' Get the first feature in part
Set swFeature = swPartDoc.FirstFeature
' While we have a valid feature
While Not swFeature Is Nothing
' Get the name of the feature
featureName = swFeature.Name
tName = swFeature.GetTypeName2
If tName = "WeldMemberFeat" Then 'weldment feature
Dim fDef As StructuralMemberFeatureData
Set fDef = swFeature.GetDefinition
Dim profilePath As String
profilePath = fDef.WeldmentProfilePath
message = "Feature: " & featureName & vbTab & tName & vbTab & profilePath
Debug.Print message
End If
' Get the next feature
Set swFeature = swFeature.GetNextFeature()
' Continue until the last feature is found
Wend
End SubThanks Michael. I'll check it out. I believe I still have your automating Solidworks book on my shelf. It was a great help when I was getting started. I just never get enough time to focus on programming to where I get great at it. Slowly but surely.
Chris
Michael,
I tried it out real quick. Your macro returned 3 values, corresponding to the 3 weldment features I used in the feature tree to create the part. I am looking for values for the 5 structural shape cut-list items, as well as a value on the 3 non-structural shapes (the ones with folder icon) if possible. The goal is to traverse the cut-list and pull the shape out so that the macro can assign a default description and material based on that shape. It isn't something I can set in the weldment profile library feature as the material and descriptions may change depending on who I work for.
Thank you again,
Chris
Here's a sample that does what you want:
public void Main()
{
ModelDoc2 mDoc = swApp.ActiveDoc as ModelDoc2;
FeatureManager fm = mDoc.FeatureManager;
object[] featObjArray = fm.GetFeatures(false) as object[];
foreach (object o in featObjArray)
{
Feature nextFeature = o as Feature;
if (nextFeature.GetTypeName2().Equals("CutListFolder"))
{
IBodyFolder data = nextFeature.GetSpecificFeature2() as IBodyFolder;
if (data != null)
{
Feature weldFeature = data.GetFeature();
object[] bodyObjArray = data.GetBodies() as object[];
foreach (object oBody in bodyObjArray)
{
Body2 nextBody = oBody as Body2;
object[] bodyFeatObjArray = nextBody.GetFeatures() as object[];
foreach (object oBodyFeat in bodyFeatObjArray)
{
Feature f = oBodyFeat as Feature;
if (f.GetTypeName2().Equals("WeldMemberFeat"))
{
IStructuralMemberFeatureData memberData = f.GetDefinition() as IStructuralMemberFeatureData;
string path = memberData.WeldmentProfilePath;
Debug.Print(nextBody.Name + " is a structural member (" + path + ")");
}
else
{
Debug.Print(nextBody.Name + " is NOT a structural member");
}
}
}
}
}
}
}Here's my sample cut list:
And here's the output:
L angle L1.125X1.125X0.125(1)[1] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[3] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[2] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[4] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
Fillet1 is NOT a structural member
Fillet1 is NOT a structural member
The hard part will be parsing out the actual shape from the path with all the different standards and such that are available.
Jim,
That's looking like it will work. I will just need to convert it over to VBA, as I haven't learned C++ yet. And then have it only return once per cut-list top level item, as I won't need each individual item in each folder. Just wanting to apply properties to the folder level.
Thank you!
Chris
Is there a way to tell what kind of structural shape a cut-list item is or barring that, that it is a structural shape vs a part made without using weldment profile, such as a plate?
This doesn't address your question, but have you ever considered creating plates as weldment features? It offers several advantages. See Using Plate in Weldments
Here's a sample that does what you want:
Here's my sample cut list:
And here's the output:
L angle L1.125X1.125X0.125(1)[1] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[3] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[2] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
L angle L1.125X1.125X0.125(1)[4] is a structural member (E:\_EPDM\Engineering\Library\Mechanical\Weldment Profiles\ANSI Inch\L Angle\L1.125x1.125x0.125.sldlfp)
Fillet1 is NOT a structural member
Fillet1 is NOT a structural member
The hard part will be parsing out the actual shape from the path with all the different standards and such that are available.