I am trying to figure out an easy way to make edge flanges of different heights, in sheet-metal module.
Presently I had done two edge flanges but there is a gap between the two. I need them combined.
As an aside to Benjamin's post, you can also edit the flange sketch by expanding the Edge Flange operation and edit the sketch listed directly under the flange op (which I prefer to do, but it's the same thing).
There is a sketch for each edge selected for that edge flange operation and if you're wondering which is which, click the sketch and it's flange will be highlighted.
Also, if you have two opposing flanges, you can edit the first listed sketch. Then edit the second sketch and reference the first sketch (such as collinear) to equate them.
You can't flip this and edit the second one before the first sketch because when you edit the first sketch, the second sketch technically doesn't exist yet.
You can click the 'Edit Flange Profile' button in the Flange feature and sketch any profile you wish...
Thank you Kevin
I dont see how this is working. Can you please show more snap shots explaining the process? I get this popup dialog when I click the edit flange button
Here's a way I fine works for me.
Mark McMullen wrote: Here's a way I fine works for me.
Mark McMullen wrote:
More maintenance, but now that that we see your desired end result, may I suggest a more easily maintained workflow:
Add an unfold operation (selecting the underside main face as the fixed face.
Start an Extrude Cut and sketch the cut profile onto one of the flanges (doesn't matter which).
Draw a construction line from the notch corner and dim it to 45°.
Mirror Entities the drawn profile about this line. Future edits to the dimmed profile will be reflected in its mirrored twin.
The 0.500 dim is just to keep the cut profile out of the part if the flange height changes.
The Sigma 0.500 is just equated to the first 0.500. The actual value doesn't matter and you can also relate these profile lines as colinear to their corresponding edges.
Be sure to check: Link to thickness:
Add a fold operation to bend it back (the previous fixed face from the unfold will already be selected).
Just click the collect button.
Draw them at one height, add a cut after wards. Use the end face of the flange as your sketch plane, draw a rectangle, cut it down to the depth you need.
This method may work, I thought of it, but I wanted the flat-pattern to reflect the actual cut.
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