Main body is section viewed in assembly file. How is it possible to have other placed parts without section viewed? Because it does not come to me.
Time 1.0
SDNR Valve Design | Complete Assembly Part 5 | Assemble with mates - YouTube
Main body is section viewed in assembly file. How is it possible to have other placed parts without section viewed? Because it does not come to me.
Time 1.0
SDNR Valve Design | Complete Assembly Part 5 | Assemble with mates - YouTube
Hello,
It could be that the part has the custom property "IsFastener" = 1.
Kevin
I couldn't understand what is meant by "IsFastener" = 1. Here is the assembly. I want to make this valve to simulate a flow process.
Maha Nadarasa wrote:
I couldn't understand what is meant by "IsFastener" = 1. Here is the assembly. I want to make this valve to simulate a flow process.
Hello,
I'm not in front of SolidWorks at the moment, so I can't review your assembly right now.
But "IsFastener" is a custom property used by SolidWorks to prevent a part from being sectioned.
Since the parts most people do not want to section in a section view are fasteners (screws, pins), the custom property is named "IsFastener".
So if this custom property is in any part file (not just a fastener part) and is set equal to one, then this part will not be sectioned when the cutting plane cuts through it.
If you have ever seen section views cut at the bolts, but the bolts weren't sectioned, only the main body was cut, then this is what the result of using "IsFastener" looks like.
You can also exclude bodies from a section by modifying the section scope.
Kevin
Thanks for the explanation.
Please show me how to make "IsFastener" = 1.
Maha Nadarasa wrote:
Please show me how to make "IsFastener" = 1.
Hello,
In the part you wish to exclude from being sectioned, create a custom property, as you would normally create any other custom property, and give it the name: IsFastener.
In the value column, enter a 1.
Creating this custom property is no different from creating any other custom property.
The difference happens when SolidWorks "sees" a custom property with this unique name (and that it is set to 1), then SolidWorks will automatically exclude the part from being sectioned in all sections that try to cut it.
So, it's an automatic feature, but we must create this uniquely named custom property (and set it to 1) to turn this feature on.
To turn it off, either delete the IsFastener property or set it to zero.
I hope this helps.
Kevin
That means if "IsFastener = 1" section view should not work. I tried with part file it is not coming.
Hello,
Just a 1 in the value column.
I'm on SW2018, so I can't open your assembly.
Kevin
Video is attached.
Maha Nadarasa wrote:
Video is attached.
My apologies as the method I was referring to apparently applies only to sections in drawings.
In a drawing section, you're presented with the Section Scope options dialog and it's here where you can exclude fasteners (anything with the "IsFastener" property set to 1):
This part has this property and as you can see, it isn't sectioned.
I believe Bjorn Hulman's post below is what fits your OP.
With "IsFastener", which is stored in the part, this will apply to all drawing view sections that cut this part, unless "Exclude fasteners" is not checked.
With Mr. Hulman's method, each component's section cut status is a property that's stored within that particular section and only that section.
And, as your video shows, is independent of the IsFastener property.
Kevin
Maha,
The method Kevin Chandler mentions is absolute gold. However, if you wish to insert a section through particular parts in an assembly which may not be fasteners, or you do not want to set as fasteners, the section dialog has a 'Section by Component' check box. You can then either set that to excluded selected parts from the section or section only the selected parts. The section dialog will remember these selectins if you turn the section /off and on until you change it. I suspect in the video they've made this selection previously.
Thanks
Maha,
The method Kevin Chandler mentions is absolute gold. However, if you wish to insert a section through particular parts in an assembly which may not be fasteners, or you do not want to set as fasteners, the section dialog has a 'Section by Component' check box. You can then either set that to excluded selected parts from the section or section only the selected parts. The section dialog will remember these selectins if you turn the section /off and on until you change it. I suspect in the video they've made this selection previously.