7 Replies Latest reply on Dec 20, 2018 11:11 AM by Ram R.

    Making an angled plane cut on a cylinder

    Ram R.

      Hi guys,

       

      Here is a problem I spent an hour trying to solve, and couldn't do it. Maybe you'll have an idea.

       

      I have this cylinder/tube:

       

      Solidworks thing.jpg

       

      See the cut at the top? It almost looks like an angled plane, but it isn't. It's an ellipsoid or something, it was caused by taking a cut of a bigger and more complex model that I won't go into.

       

      Long story short, I want to make a true angled plane cut on that cylinder, that's going to be as close as possible to the complex cut. (i.e. an approximation.)

       

      I was basically thinking, take the highest point of the cut and the lowest point of the cut. Make a line between them, and a line from each of them to the flat bottom of the cylinder. Take the plane that intersects the two points and is perpendicular to the plane defined by the 3 lines.

       

      But, I don't know how to define in solidworks "The highest point in the cut". I want the point in the circumference of the cut that's the farthest away from the base of the cylinder. How can I mark that point in Solidworks?

       

       

      Thanks for your help,

      Ram Rachum.

        • Re: Making an angled plane cut on a cylinder
          Jason Young

          you need to create construction geometries to create the plane,

          there are several ways to do this.

          hope you can op 2019 files.

           

          Plane2.JPG

          Plane.JPG

          • Re: Making an angled plane cut on a cylinder
            Rubén Rodolfo Balderrama

            Could you upload your file?

            • Re: Making an angled plane cut on a cylinder
              Jason Young

              you will not be able to create a flat plane from 3 lines.

              if all 3 lines are already on the same plane, SW will reject the 3rd line.

              however, if the 3rd line is not on the same plane, it will add it and create a curved surface, to force them to fit.

              this may be the reason you are getting a curved surface.

              • Re: Making an angled plane cut on a cylinder
                Newell Voss

                You could offset a plane from the base face and set it tangent to one of the inner/outer edges.

                Otherwise just sketch a line on the plane that bisects the angled cut attached to the high/low tangent points and cut with surface. close enough judging by the views provided.

                • Re: Making an angled plane cut on a cylinder
                  Matt Lombard

                  If I understand your question correctly, this is how I'd do it. I'm not sure about the nature of the cut you have, so I just approximated something that sort of looks like yours.

                   

                  • Sketch on a plane that goes through the centerline of the cylinder.
                  • draw the black line from midpoint of upper angled edge to the midpoint of lower angled edge
                    NOTE: in my model, there's some problem. I can't get the lower edge to project into the sketch plane, or make any sketch relations to it.
                  • Draw the blue line perpendicular to the black line
                  • Make a plane through the blue line perpendicular to the sketch plane
                  • If you want to extend/trim the cut face of the cylinder to the new plane, make a planar surface on the new plane and use the Replace Face feature, which will both add and remove material to give you an angled but planar end face.

                   

                  • Re: Making an angled plane cut on a cylinder
                    Daen Hendrickson

                    To build on Matt's approach...

                     

                    You could create a 3D sketch and use convert entities on the outer or/and inner edge. At least with my approximation of your model, this created an ellipse with a VERY convenient point entity at the lowest point (circled in red).

                     

                    From that point I created some reference geometry:

                    • A line [LINE 1] from the circled reference point to approximately the highest point on the ellipse.
                    • A line [LINE 2] coincident with the axis of the cylinder
                    • Set the Mid-Point of LINE 1 coincident with the End Point of LINE 2 - This could probably be done with an axis in place of LINE 2
                    • Set the opposite end of LINE 1 coincident with the ellipse
                      • This caused errors in my sketch - I expect there is a slight geometry mismatch but I did not dig into it
                      • As a work around I added a point and made it coincident with both the ellipse and LINE 1
                    • A line [LINE 3] perpendicular to LINE 1 and coincident with LINE 1's mid-point
                    • A line [LINE 4] with endpoints coincident with LINE 3 endpoint and LINE 1 "circled" endpoint.
                    • A point made coincident with both LINE 2 and LINE 4
                    • If you wish, make LINE 2 and LINE 4 perpendicular to fully define the sketch.

                     

                    From this you can create a plane by selecting the endpoint of LINE 3 as well as LINE 3. This plane will be "IN PLANE" with the ellipse. From there you can replace face, cut with surface, etc.

                     

                    NOTE, this entire approach relies on the automatic creation of the lowest point of the ellipse. No need to determine any angles, dimensions, etc. Not necessarily better, just an alternative means to the end.

                     

                    Daen