Was going to give the new Structure System a test, and none of the weldment profiles show up. The "standard" list populates as should, but "type" and "size" doesn't pull anything from the folders. Working just fine in weldments.
You need a configured weldment library. The default library isn't. How to create a configured weldment profile is mentioned in the weldment training material. I believe there is a download with a configured library. The new 2019 library is configured by default.
S-075348 When I create a structure system in the SOLIDWORKS® software, why are my weldment profiles unavailable?
Structure systems use only configured profiles.
In previous SOLIDWORKS® versions, the sample weldment profiles each contained one configuration. The folder structure of the weldment profile directory determined the standard, type, and size of each profile. In this setup, each SLDLFP file represented a size.
In the SOLIDWORKS 2014 version, it became possible to add multiple configurations to a weldment profile.
Effective with the release of SOLIDWORKS 2019, the sample weldment profiles each contain multiple configurations. The folder structure of the weldment profile directory determines the standard and type. In this setup, each SLDLFP file represents a type and contains multiple sizes.
Structure systems require the latter setup in which the folder structure determines the standard and type and the configuration determines the size.
To convert custom weldment profiles to the newer format:
1. Edit the SLDLFP file and add a configuration for each size.
2. Configure the sketch dimensions as necessary.
3. In Windows® Explorer, move the SLDLFP file up one level to the folder for the standard.
Structure systems are available effective with the SOLIDWORKS 2019 version.
It doesn't seem to have installed any configured weldments. Where would I be able to download the 2019 samples?
It should be in C:\Program Files\SOLIDWORKS CORP\SOLIDWORKS\lang\english\weldment profiles (the ansi inch.zip)
Thank you for uploading the Configured Weldment Profiles.
How did you got it from Solidworks or you make it by yourself?
I got one from SolidWorks, the other from the installation of 2019.
your configured profile has all the ansi profiles but for ISO there are only few profiles.
Hi Ruban Anthony,
I never reviewed the content myself, but I believe you are right.
Depending on the type you are missing, dimensions can be (easily) added as the profiles are "configured". But I think T-section would need some sketching. I think a weldment library should be personal, i.e. not all dimensions of the profiles mentioned in the Standard are available on the market or lying around on your shop floor.Kind regards,
i'm a solidworks trainer, i need to show the trainees that solidworks supports all standards. i'm okay with weldments, but since this structure system is new i'm having few troubles, as you said no one needs all profiles since they can customize it according to their needs, but any student would have same question as mine, and that would e why structure system doesn't show any of the downloaded profiles while weldments does? and i'm also aware that structure system shows only configured items. is there any other way to show all the downloaded profiles in structure system?
I have the same problem aswell, the thing is i don't have any zip files in the solidworks installation file, so i downloaded the profiles from solidworks content tab, since i need it for training purpose i want all profile standards and so downloaded all of them, but as kyle said the profiles are not showing in structure system but works fine in the weldments.
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