So i have a view that i have rotated and i want to put horizontal ordinate dimensions but they come off as angled before i rotated that part.
I would like to have them horizontal.
Ben Langdon wrote:
So i have a view that i have rotated
Don't do that. Ever. It is never necessary and often leads to problems like this. Add a custom view in the model oriented the way you want your drawing view and then use that view in your drawing.
Jim Sculley wrote:
Ben Langdon wrote:
So i have a view that i have rotated
Don't do that. Ever. It is never necessary and often leads to problems like this. Add a custom view in the model oriented the way you want your drawing view and then use that view in your drawing.
Agreed. While Rotate view has some uses....I think I have only ever used it once.
Adding a new view inside the model is the best way (as Jim Sculley has already pointed out).
Then Ordinates work the way you want them to:
so i made that face with the two holes in it (looking at hidden lines, from the view i showed) normal to my view and then updated the standard views to make the top view rotated by 10 degrees, i.e. so that the top view is rotated 10 degrees.
how would i have done this with a new view, like looking normal to the face, but wanted it rotated 10 degrees or w/e angle.
you can rotate the View, but i would still dimension the Bolt circle to the center.
Ben Langdon wrote:
so i made that face with the two holes in it (looking at hidden lines, from the view i showed) normal to my view and then updated the standard views to make the top view rotated by 10 degrees, i.e. so that the top view is rotated 10 degrees.
how would i have done this with a new view, like looking normal to the face, but wanted it rotated 10 degrees or w/e angle.
There are a few ways:
1) Create a plan plane that is 10 degrees off of vertical. Then Select the front plane (or whatever plane is perpendicular to our point of view) and then CTRL select the 10 degree plane. Then hit normal to. This should bring you to the orientation that you need. If it is backwards, then flip the Normal direction of the 10 degree plane. Then create your new view.
2) Read this blog post:
How do I manipulate my model view; let me count the ways
Excerpt from there:
So change your increment to 10 degrees and ALT select the axis you want to rotate around. Then create your new view.
One way would have been to make a Plane in your part file using the temp axis of the 2 holes that are in line there in your drawing. Use that plane to get a normal view, hit the arrow key a couple/few times (depending on what you have your rotate view by arrow key increment option set at), to rotate the view 90 degrees and save that view. Then pick that view from the list when creating a new view in your drawing like Phil did above.
Optionally, If you have the (rotate view by arrow key increment option set to 10 degrees) you could just hit the arrow key down 9 times and left once. Then save that view.
