I'm trying to figure out, is it possible and is it necessary to have thread callout (in my case it is 1/4NPT) on annotation view through MBD?
If you've used the hole wizard to create the threaded hole, a size dimension should create a thread callout for you:
This is my problem. Maybe I'm doing something wrong. I do not have this callout.
I created new part with whole through the wizard, and still nothing.
It may have to do with whether or not the annotation view that the hole call out is on or not. Check to see if that annotaion view is on or off. If it is on, then it might be a view orientation issue.
I've tried all views...Doesn't work...
first of all, welcome to the SOLIDWORKS forums! My welcome is even warmer since you're joining this area that is passionate for MBD, the future of communication.
I apolgize for the inconvenience that happened.
DimXpert, or better, MBD Dimensions (that's how we call it in SOLIDWORKS 2019) has ben designed to recognize a vast number of manufacturing features, including holes, therefore, as Logan suggested, an MBD size dimension should create a hole callout.
My recommendation is connecting with your VAR and send them this model to check what could be source of this issue.
Please let us know about your findings.
Thanks for you answer, I'm not sure what do you mean by the VAR.
that stands for Value Added reseller.
By the way, what's your aim in this case ? Are you going to use this model for drawingless manufacturing (i.e. sending this directly to manufacturing ot a 3D PDF) ? Or do you need to leverage on PMI information for other processes like tolerance analysis ?
If your aim is just creating some 3D views for a drawingless model, you could use this "creative approach"
1) Model the hole with advanced hole feature (DimXpert GD&T rule checker seems to ignore it and this will result in having no errors when creating position tolerance)
2) Creare a pattern feature (collection) that would include conical portion of the hole, tapped portion, and final cone)
3) Insert a position tolerance (when clicking it will highlight all the above features)
4) Use a note with multiple braches to mimic the callout (each branch will reference an entity giving ability to click on the note and get visual feedback on the hole callout)
Hope this helps.
Thank you for your answer and explanations.
This is my problem, I don't want to mimic the callouts, because I have some parts where can be 10s of threaded holes.
according to my knowledge, SOLIDWORKS MBD provides ability to add an MBD size dimension to a hole feature resulting in creation of a hole callout with quantity. Moreover, patterns are reconized most of the time, therefore, when clicking on size dimension, all holes of that size would be cross-highlighted.
When you mentioned 10s of threaded holes, do you mean that you're mostly creating NPT holes ?
If so, are you using MBD to create a drawingless representation of hydraulic manifold blocks like these ?
I have parts for a machine some of them have installation holes with treads. I can't get callout for non of them, but a blueprint there are appearing.
I found out that, the problem appears just with "tapered tap" holes. Maybe I have problem with files or something.
I worked through this issue with my VAR this week.
Right now; with SW 2019/2018, MBD can recognized a simple hole feature with threads and maybe one countersink on the nearside. This is defined in txtcalloutformat.txt
More complex holes we are use to in the drawing files as defined in calloutformat.txt are not supported by txtcalloutformat.txt. The variable nomenclature different in the MBD hole call outs compared to the drawing call outs. You can see the different Auto Dimension Scheme Call outs below based on hole complexity.
Hole thru, threaded, nearside countersink. The hole is identified as a threaded hole with a chamfer as shown in the callout.
Hole thru, threaded, nearside and far side countersink. The hole is broken down to cones, chamfer, and hole diameter.
So, it means we don't have any solution right now?
I didn't come up with a good solution with my VAR except to add all the notation manually in the Dimension Text property box or to work around the features one-at-a-time to add associative dimensions. Unless there is a Swift Callout Variable for the extra features similar to Hole Wizard, I don't think we have many options here.
This is one "must have" that should be in MBD Dimensions. There is also an SRP for the lack of a hole table in MBD.
It is "must have". I'm unable to create blueprints fast and efficient. Sometimes my parts can have up to 20 1/4, 1/8, 1/2 NPT holes.
I found I can do simple holes, threaded simple holes, counterbores, and near side countersinks in MBD. If found more complex far-side, mid-side countersinks will break the callout.
You can create a series of text callouts in Word/Notepad to cut and paste in the Dimension Text Property field.
Are you doing drawings? You mentioned blueprints.
Problem exist just for tapered threaded holes.
Usually I share my 3d models or drawings, but I do blueprints for some manufacturers.
there are some interesting improvements in SW 2020. I think this limitation has been overcomed.
You can test SW 2020 Beta Online from My SOLIDWORKS:
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