Hello, I'm trying to make a standard note for surface finish to drag from library.
I created the 'Note' annotation inserting the symbol
between brackets, spaces and comma getting the following note
Then I saved it in the library.
If I try to insert the note from library to a new drawing I get the following:
What am I doing wrong?
Hello,
It's not just surface finish symbols.
This error appears for each of these entities (datums, GD&T fames, etc.) inserted into a note, saved as a library feature and then added into any drawing other than the source drawing.
There's no option for breaking references either, like with assemblies.
This works with text-only notes though.
Seems like it should work as it does for text-only, so perhaps you can report this discovery to SW as incorrect behavior.
Sorry, not much help,
Kevin
Years ago I use to put standard note blocks on the drawing template, outside the sheet border. When needed I could drag them inside the sheet!
Nowadays, with such a powerful CAD as SolidWorks, I expect I could do something better...
It is definitely a bug ...
I'm still on SW2015, don't know whether the issue has already been solved on later versions.
Sergio Monti wrote:
Years ago I use to put standard note blocks on the drawing template, outside the sheet border. When needed I could drag them inside the sheet!
Nowadays, with such a powerful CAD as SolidWorks, I expect I could do something better...
It is definitely a bug ...
I'm still on SW2015, don't know whether the issue has already been solved on later versions.
I'm on SW2018, sp2 and I'm still getting this.
Kevin Chandler wrote:
I'm on SW2018, sp2 and I'm still getting this.
Tested it on 2018 SP 4.0 and works as expected.
Deepak Gupta wrote:
Kevin Chandler wrote:
I'm on SW2018, sp2 and I'm still getting this.
Tested it on 2018 SP 4.0 and works as expected.
Thank you, sir. That's good news.
Years ago I started saving often used Notes as Styles instead of in the library because of an error when trying to insert the same Note more than once in the same document. I'm still doing that, but I just did some testing and it looks like that doesn't work for surface finishes either.
I also have some notes that I use less often, but still need occasionally, and I didn't want them cluttering up the drop-down for Styles. I saved them in a separate Drawing, and have it pinned in the Recent Documents list. When I need one of those Notes I open this document and copy and paste Notes as needed. I see that you said you've saved some notes in your templates outside the drawing sheet to drag in when needed. If you don't want them cluttering up your graphics area off the sheet you might try that instead.
Sergio Monti wrote:
I'm still on SW2015, don't know whether the issue has already been solved on later versions.
Works for me on SW2015 SP 5.0 as well. Can you attach your files to check?
Hi Deepak, I'm on SW2015 SP 5.0 too.
Please find attached file to check! I also attached the drawing template I'm currently using.
Thanks
It is showing broken for me as well. Can you try the attached one and see if that is working for you.
Hello,
Mr. Schroeder's reply reminded me of another method: blocks.
Create the note as usual, save it as a block (renamed according) in the same folder as your Library notes are stored.
Then drag and drop the block onto your new drawing and it works.
But for some reason, the block version shrinks the surface finish symbols (highlighted), but when you explode the block (an exploded copy of the block is on the right), they're restored:
This is on a new drawing, not the original where I created the note and block.
Perhaps this is a workaround for you until you upgrade to SW2018 sp4 as Mr. Gupta mentioned.
Kevin
Thanks Kevin, that's could be a good option for me at the moment, as I need to explode it anyway to change values (it' quicker that edit the block) so I will mark your answer as correct.
Sorry Glenn I know your solution in good, too!
I did some trials and it looks like I don't have issues with shrikage of symbols.
I also experienced the problem with the wrong scale importing block containing note and lines, and, as well, I solved the issue exploding the block.
I noticed that the problem occurs on notes included in sub-blocks and I believe it depends on difference between the actual scale of the drawing and the scale of the drawing of the block when it was created.
Apparently SW is able to recalculate font dimension on blocks according to the actual scale of the drawing but is not able to do it on blocks included inside the block (sub-blocks).
Look at the example below.
The block was crated on a drawing with sheet-scale 1:1. When imported on a drawing having sheet-scale 1:2 is like:
after been exploded is like:
'12' and '10' are notes inside the block but
is a 'block inside the block'. Once exploded it becomes a 'first-level' block and SW is able to calculate the correct font size.
This is my understanding to the 'strange' behaviour.
Hello,
Mr. Schroeder's reply reminded me of another method: blocks.
Create the note as usual, save it as a block (renamed according) in the same folder as your Library notes are stored.
Then drag and drop the block onto your new drawing and it works.
But for some reason, the block version shrinks the surface finish symbols (highlighted), but when you explode the block (an exploded copy of the block is on the right), they're restored:
This is on a new drawing, not the original where I created the note and block.
Perhaps this is a workaround for you until you upgrade to SW2018 sp4 as Mr. Gupta mentioned.
Kevin