I did not find answer for:
there is hole feature, holes positions are definened by 3D sketch, so holes axis are perpendicular to different faces.
How I can insert "hole derived pattern" the way my bolts alined parralel to holes.
Now axis of all bolts of pattern are parallel .
hi Igor,
Are you inserting the 'bolt' inside part? Your method should work in assembly. Can you attach your files?
Hi Sachin, this looks good. May I ask how you created the holes? Was it done through a sketch driven pattern?
You can try place first hole point on non planar surface.
I get different result every time. I shall send models and comments little late.
hi Tan,
When you are locating position of holes select 3D sketch in hole wizard and place your points on 3D surfaces. You may want to put extra sketch entities to properly locate holes at desired position.
In assembly, place the bolts. Do a 'pattern driven component pattern' and select holes as driving features
Hi Sachin
Thank you for the advice. I was able to get this to work. I am very surprised to find out that the hole wizard feature is actually recognized by the pattern driven component pattern as a driving feature.
Even though we are not able to create the holes with a sketch driven pattern, we are still able to use the hole wizard feature as the driving feature to populate the bolts. I have learnt something new today!
This is interesting. Have I understood correctly?
If holes are placed on a 3D surface using the hole wizard, then a pattern of fixings based on that hole wizard feature follow the correct hole orientation and are placed perpendicular to the surface, in line with the holes?
That is remarkable, when any other 3D sketch driven hole pattern is used to drive fasteners they all come in facing the same way, when the holes are on different orientated faces. Making the feature driven pattern feature useless for most 3d sketch driven features.
https://forum.solidworks.com/message/270843?q=pattern%20driven%20by%203D%20sketch%20holes
I just tried it.
It does seem to work!
SW2018, SP3
John
Hello community
There are three configurations in the assembly (and three configurations in housing).
A brief study showed that
SW recognizes the correct direction of the holes in any case.
But the alignment of the bolts is done differently.
Execution 00 - the first hole is located on a flat surface
Execution 01 - The first hole is located on a surface with a double curvature
Execution 02 - all holes are located on surfaces with double curvature
It is assumed that the correct location of the bolts will only be if all holes are located on ONE surface.
Could you attach your file?
Hi Igor, I have tried doing this in the past with a sketch driven pattern (points in a 3D sketch). Unfortunately, the patterned holes would always follow the same plane as the seed hole. I think the next best method is to activate 3D sketch in hole wizard while doing placement. At least with this option, you can place holes on different planes, although it will definitely be a pain if you have many holes.