as attached, how to fix the red circle gaps other than using projected plane with 3D sketch.
You can add a sketch and extrude it to a surface toohttps://www.youtube.com/watch?v=NILQ_wuqMf8
You can open a sketch on the bottom face of the Extruded Base and extrude the Sketch to the Surface of the revolve. Use the "Up to Surface" option and pick the tapered surface.
You can do as Mukesh suggests, you could also use the Move Face feature to move the two faces until they completely merge.
Hi John, go into your sketch 4 and have the line circled in red below go down into the round disk shaped part.
EDIT: I just noticed you didn't have the checkmark for the "merge result" checked in the Boss-extrude1 so you will have one solid model instead of two solid bodies. Tom
Hi John ,
If the part is to be one piece you could extend the sketch and select merge result.
If the part is to have two bodies I would go with Bjorn and move the face. (I changed the sketch slightly for that once as the function didn't like touching the mating face to start with).
Lots of way to skin a cat. I could not open his model since I am using SW2016 so I was going by just the attached image.
Another way is to copy the tapered surface and use "Replace Face" to replace the bottom face of the Extrude Boss with the copied surface. To do this you need to un-check the "Merge Result" and after the replace face operation, you can combine the bodies if you are interested on a single body.
What's the cat done wrong?!!
Yes Mukesh Lots of options available in SW. That's why we love it so .... right?
thank you guys for all the advice and possibilities, appreciate that =)
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