Hello
I have created a custom part template, with my own properties linking to my title block on drawings.
Right now it works fine creating a drawing from a part, I get all the properties on to the drawing.
If I create an assembly from my part file and then create a drawing from my assembly, I don't get any of the properties.
How do I link the same properties to an assembly template?
I would like for the properties to show on the drawing, whether I create an assembly or not.
Hello Bjorn
I have added the custom properties to the part template, through the File Properties.
This was before I knew about the property tab builder.
I'll take a look at the link to Javelin-tech.
Just to make sure I understand the situation, you have custom properties in your Parts that are linked to notes in your title block so they're filled out when a drawing view of the Part is inserted into a Drawing. That's working fine. However, these notes aren't working properly when you insert a drawing view of an Assembly. Is this correct? If yes, have you assigned the custom part property to the Assembly?
Yes, the text in the title block is filled out, when I insert a view of the part.
That it correct, it doesn't work when I insert a view of the assembly of the part. I have assigned the same properties to
the assembly and that works fine too. But the properties in the assembly are not linked to the properties in the part. So, should I
update, say, the material in the part file I would have to do so manually in the assembly too. That is what I would like to avoid.
Assigned the custom part to the assembly, do you mean the properties? I'm not sure I understand.
I talked to our VAR about it and the conclusion was, SW has no way of linking (or importing) properties made in a part to an assembly.
Maybe there is a macro out there as Bjorn Hulman said.
Yes, I did mean property instead of part. Sorry about that.
And I'm also not aware of any way to link a Part property to an Assembly property without a macro.
No problem.
Our VAR couldn't help either, but they encouraged me to write an ER. So I did.
Meanwhile, I'll try to find a macro for it, since my own macro skills = 0 :-)
What's the assembly Marc?
What you can do when you start the drawing is place the part in first, which will then drive the title block data. You can then add assembly views to suit.
I do this for sheet metal parts where the initial view is the blank, then add views with the fasteners / inserts etc. That way I don't need to add the data to the assembly level.
The part file is full of weldments, columns and beams.
In the assembly I added fasteners to the columns and beams.
You are right, I could just insert a view of the part file, then hide the view and insert views of the assembly.
The hidden part view will still drive the title block in new sheets.
I am going to write an ER on this, it should be possible to make the assembly inherit the custom properties made in the part file.
I have written an ER on this subject. ER:1-17387697466.
I will also post it in the Hype your Enhancement Request thread.
Hi Marc,
How are you adding the properties to the part? Are you using the Custom Property Tab? You can setup all the fields you want and create entry fields that make data entry a lot quicker. https://www.javelin-tech.com/blog/2017/04/solidworks-custom-property-tab-builder/
The drawing of an assembly will be looking for the custom properties in the assembly, not the parts within said assembly. If you want the exact same data from a part in the assembly as well, you'll likely find a macro on this forum that does that.