This new plane(Plane 1) is referenced using front plane, with a 50 deg. angle. I used the red circled line for the second reference. Goal is I want the new plane to be 50 degrees from the front plane.

This new plane(Plane 1) is referenced using front plane, with a 50 deg. angle. I used the red circled line for the second reference. Goal is I want the new plane to be 50 degrees from the front plane.

If I am understanding what you are asking, you should be able to edit the plane and change the reference for that plane. In other words where it is set to be parallel to plane x you can set it to be perpendicular. As and alternate you can create a new plane that is perpendicular to the existing plane and provide a reference point where you would like the plane to start.

Hope this helps and is not to confusing

Hi Tremain

There's usually a way to get it the way you want, here I worked 50 degrees off the right plane

Plane 1 was defined by a sketch on the top plane

Plane 2 was defined by a vertical line (axis) on the front plane

So you can choose which way...

**If I remember correctly when you use a line to define a plane that becomes the horizontal**An 'out there' solution is to use a 3d sketch.

Planes defined in 3dsketches are able to spin, so you can apply a horizontal AND a parallel relation to whatever you want

2016 attached

A little lost in this illustration.

*First pic on top shows

**Plane 1**formed by**Top Plane**and**horizontal construction line**that I assume is normal to**Right Plane**.**Horizontal**and**vertical construction lines**are sketched on**Plane 1.***The second pic from the top shows the

**Right Plane**is 50 deg. from**Plane 1.**You reference the**horizontal construction line**sketched on**Plane 1**and the**Right Plane**.*****The third pic shows**horizontal construction line**drawn on**Plane 1**and references**Top Plane.*******The fourth pic referencessketched on**vertical construction line**and references**Plane 1**.**Top Plane*******The fifth pic uses the**Plane 2**formed assumingly created from using the**Top Plane**similar to how**Plane 1**was made**.**A sketch is made then on**Plane 2.****Plane1**(Horizontal consistency WRT Front & Right Plane)**Plane 2**is exactly coincident with Plane 1but as you can observe vertical and horizontal have been swapped

Plane1 from a sketch line on the top plane (that defines the angle) perpendicular from Top Plane

For Plane2 the angle is defined in the plane feature, the axis is a vertical line on the front or right plane

So you have two outcomes from these two techniques, which allows you to choose which is more convenient.

If you define a plane through rotation the axis becomes the horizontal, avoiding this gives you the other way

Tremain Sharp wrote:

This new plane(Plane 1) is referenced using front plane, with a 50 deg. angle. I used the red circled line for the second reference. Goal is I want the new plane to be 50 degrees from the front plane.

Solidworks seems to randomly decides which way is up in a sketch, it's not a property of the plane (I think).

For example,

Sketch on the Top Plane, up is in the -z direction.

but

Sketch on the Right Plane. Edit the sketch plane top to Top Plane. Up is now -x direction. So, same plane, but different up direction.

This is an issue I've had with SolidWorks for a long time. When you try to create a new plane by using an existing plane and rotating about an axis, the software rotates the plane 90*. So now if you create a sketch on the new plane, your vertical is now horizontal, and your horizontal is now vertical. There was a time when this didn't happen. I've sent in information to fix this, but it has gone unanswered for many moons. I'm starting to think that this is intentional, though I have no idea why.

Your best bet is to start using construction sketches to create your planes. That's what I do now to avoid such issues.

Where do you think you are? NX forum?

I’ve done a lot of freaky shapes in SW. in that time, I’ve all but abandoned the use of horizontal and vertical constraints, mostly because SW does not allow control of horizontal reference like NX and Creo have for over 20 years.

in place of that, I add construction lines to govern my X-Y reference and constrain parallel or perpendicular to those as required.

it May add a minute or two to the initial sketch build, but will save many more over the life of the design.