AnsweredAssumed Answered

Help! Have a complex curve part that I want to hide part of, and it won't let me make a dwg.

Question asked by Barbara Blanc on Apr 4, 2018
Latest reply on Apr 5, 2018 by Barbara Blanc

Like • Show 0 Likes0
Comment • 18

Help! Have a complex curve part that I want to hide part of, and it won't let me make a formal drawing.

Hello. I have a complex curved part model, that I want to hide the middle part of -that was made using the Thicken 1 command. My intent is to hide the middle part of the glass - it is a curved piece of glass - for clarity, then in the Drawing the views shown are not complete. Only the brackets show up.

When I try to import this model into a Drawing, the views are messed up. If I try to hide the Thicken1 command, or even try to change the transparency, or try to manipulate the Thicken1 command, I get errors in the Drawing views.

I have tried to import the model as-is, and show the entire piece of glass as shaded, and manipulate the lines, one by one - or even convert it into a sketch, but to no avail.

The thing is, we have been successful with one other model/drawing that was created, and were able to hide the middle part of the glass, but my co-workers says he doesn't understand why/how it happened. Looking at both their separate trees, they were created differently. But, both have the Thicken command.

Please help. I am under the gun.

Thank you,

Barbara

Attachments

22608_R1a.zip10.1 MB
22608_R1a.JPG88.1 KB

No one else has this question

Outcomes

18 Replies

Steve Calvert Apr 4, 2018 2:28 PM
Mark Correct
Correct Answer
If the glass is a component, just hide it in the drawing or make a specified configuration that hides it or display state that hides it.

Steve C
Like • Show 0 Likes0
Actions
- Barbara Blanc @ Steve Calvert on Apr 4, 2018 2:45 PM
  Mark Correct
  Correct Answer
  Hello Steve,
  
  This does not work.
  I tried it, and received the same result that I have been. Only the brackets show up. See attached.
  
  I tried hiding the center Thicken 1 part of the glass, and used this as my configuration, but it did not work.
  
  Barbara
  Attachments
  - 22608_R1bb.PDF70.8 KB
  Like • Show 0 Likes0
  Actions
  - Steve Calvert @ Barbara Blanc on Apr 4, 2018 3:08 PM
    Mark Correct
    Correct Answer
    I'm sorry, I'm on SW2015 so I can't open your zip file to check for myself and that makes asking questions like this pertinent to solving your problem. I'm not really sure how this is created, can you show me a pic of your assembly tree so I can see what the glass is?
    
    Steve C
    Like • Show 0 Likes0
    Actions
    - Barbara Blanc @ Steve Calvert on Apr 4, 2018 3:16 PM
      Mark Correct
      Correct Answer
      Hello Steve,
      
      That's okay. I understand. I will just attach the actual part file since the file size is not that much different than the zip file.
      
      I hope this helps!
      
      Thank you for helping me.
      
      Barbara
      Attachments
      22608_R1a.SLDPRT.zip10.1 MB
      Like • Show 0 Likes0
      Actions
    - Dan Pihlaja @ Steve Calvert on Apr 4, 2018 3:17 PM
      Mark Correct
      Correct Answer
      Sorry for answering for you Barbara, but I happened to have it up.
      
      It isn't an assembly. It is a single multi body part.
      
      And the area that she wants to hide (the see through portion) is not a body in and of itself. It is part of the rest of the "Fillet1" body. Which is why I suggested making a cut that will only show in that one drawing view.
      Like • Show 0 Likes0
      Actions
      - Barbara Blanc @ Dan Pihlaja on Apr 4, 2018 3:23 PM
        Mark Correct
        Correct Answer
        Hello Dan,
        
        No, that is quite alright. I am not, by any means, an expert at SW.
        
        That is why I come here to ask questions.
        
        This is not something that I, myself, created. And, I don't pretend to understand it all. I am just trying to make modifications to it, and to make a drawing of it - and there are eight of these pieces of glass that I am tasked with.
        
        So, I appreciate the help that I have been given so far, as well as the insight.
        
        I am working on making the cuts to the glass as we speak, and then onto the configuration that you had suggested.
        
        I appreciate your help.
        
        Thank you,
        
        Barbara
        Like • Show 1 Like1
        Actions
Dan Pihlaja Apr 4, 2018 3:01 PM
Mark Correct
Correct Answer
Just select your drawing view and then select "Select Bodies" from the left. It will switch to your part. Expand the Solid Bodies folder and Shift select all the bodies, except the glass.

See attached video

Edit: pretty sure that I misunderstood what the OP was talking about.....please read the post below instead.
Attachments
- SelectBodies.mp44.3 MB
Like • Show 0 Likes0
Actions
- Dan Pihlaja @ Dan Pihlaja on Apr 4, 2018 3:01 PM
  Mark Correct
  Correct Answer
  Nevermind......I think that I misunderstood what you wanted.
  
  OK....what I would do is create a separate configuration of the part and call it "for drawing" or something.
  Then make and actual cut in the part and suppress it when you are NOT in the "for drawing" configuration. Then just use that configuration for the drawing view.
  Like • Show 1 Like1
  Actions
Paul Salvador Apr 4, 2018 5:59 PM
Mark Correct
Correct Answer
Hello Barbara,.. not sure but are you trying to view or NOT trying to view the surface ("Split Line 4")? (image attached)
If you are,.. then you would need to click on your view and then your menu,.. Insert/Model Items... then go down to Reference Geometry and select the Surface icon.
..otherwise, ask "andrewro" ? (the name used on the file before your edits)

..also/alternatively,.. in the model, you can do a Insert/Features/Delete Body - "Split Line 4".. and/or create a config for it as Dan suggest for just the drawing view(s).
Like • Show 1 Like1
Actions
- Barbara Blanc @ Paul Salvador on Apr 5, 2018 9:27 AM
  Mark Correct
  Correct Answer
  Hello Paul,
  
  Thank you for answering my question.
  
  After trying out your first suggestion, I was able to make the drawing with the middle part of the glass being transparent - which is what I had wanted in the first place.
  
  I had tried out Dan Pihlaja suggestion, but was having trouble making the new configuration last night. In making the new configuration, some of my brackets disappeared, or became slightly transparent. I was feeling very frustrated with this, and was going to ask for help with this when I received your (Paul), suggestion.
  
  Thank you all for your help.
  
  Barbara
  Like • Show 2 Likes2
  Actions
  - Dan Pihlaja @ Barbara Blanc on Apr 5, 2018 9:32 AM
    Mark Correct
    Correct Answer
    Sorry about that...I may have misunderstood the question. Are you only trying to show the glass and brackets? Or are you trying to hide the glass entirely?
    Like • Show 0 Likes0
    Actions
- Dan Pihlaja @ Paul Salvador on Apr 5, 2018 9:31 AM
  Mark Correct
  Correct Answer
  Ahh, I thought that she was trying to cut out the area that I have highlighted in red:
  Like • Show 0 Likes0
  Actions
  - Barbara Blanc @ Dan Pihlaja on Apr 5, 2018 9:42 AM
    Mark Correct
    Correct Answer
    Hello Dan,
    
    I appreciate your help on this.
    
    I was trying to make the Drawing file more realistic looking when I go to dimension it and show that the middle part of the glass is not as dark-looking. So, I wanted to either, hide or cut out or remove that center part of the model - whichever way I could - in order to make the Drawing (PDF file), look more realistic.
    
    I did not create the model. The person who did create the model is no longer here. He was more advanced in SW than I am. So, I did not understand the whole part file that he had created.
    
    That is why I am here.
    
    But, what I did find out, when I tried to cut out that center part - I first tried to convert entities, and then was going to make a cut...after converting the entities, the center part was made out of a spline - which had errors. I found out that the spline was not complete - there were two places where it was not connected. That could have been a problem area. I fixed it, and then was going to make the configuration, when i found my configuration error.
    
    Again, thank you all for your help.
    
    Barbara
    Like • Show 0 Likes0
    Actions
    - Barbara Blanc @ Barbara Blanc on Apr 5, 2018 1:26 PM
      Mark Correct
      Correct Answer
      Hello,
      
      I do not know if this should be a new topic or not, but it is related to this same original topic, but here goes.
      
      I am working on making the Drawing file now, and dimensions and everything when I just noticed on the model in the Drawing, there is a splash of color (grey), that doesn't belong there and I don't know why. It wasn't there earlier today when I was dimensioning the drawing, and then I looked up and there it was. It is up near the top of the glass in the black part of the glass. It doesn't make sense.
      
      I am attaching the files so you can see.
      
      When I open the model file, the splash of grey color is not there.
      
      Please help.
      
      Thank you,
      
      Barbara
      Steve Calvert, @Dan Pihlaja , @Paul Salvador
      Attachments
      22608.SLDDRW.zip406.0 KB
      22608.SLDPRT.zip10.2 MB
      22608-error.PDF99.8 KB
      Like • Show 0 Likes0
      Actions
      - Dan Pihlaja @ Barbara Blanc on Apr 5, 2018 1:45 PM
        Mark Correct
        Correct Answer
        Barbara Blanc wrote:
        
        Hello,
        
        I do not know if this should be a new topic or not, but it is related to this same original topic, but here goes.
        
        I am working on making the Drawing file now, and dimensions and everything when I just noticed on the model in the Drawing, there is a splash of color (grey), that doesn't belong there and I don't know why. It wasn't there earlier today when I was dimensioning the drawing, and then I looked up and there it was. It is up near the top of the glass in the black part of the glass. It doesn't make sense.
        
        I am attaching the files so you can see.
        
        When I open the model file, the splash of grey color is not there.
        
        Please help.
        
        Thank you,
        
        Barbara
        Steve Calvert, @Dan Pihlaja , @Paul Salvador
        In your both the part and the drawing, what do you have set here?
        
        This is what I have:
        Drawing:
        
        Part:
        
        I am not sure that this is the issue, simply because these settings are probably the same as what you have....but I just wanted to be sure.
        I am not seeing the splash of color. But then...
        When you have surfaces that overlap each other perfectly, Solidworks generally shows it like that. If you changed it away from shaded, it will go away. Alternatively, moving some of those sliders in the pictures above may take care of the problem as well. (or might make it worse....you will have to play with it).
        Like • Show 0 Likes0
        Actions
        Barbara Blanc @ Dan Pihlaja on Apr 5, 2018 2:09 PM
        Mark Correct
        Correct Answer
        Hello Dan,
        
        Thank you for looking into this.
        
        The splash of color (grey) is near the 18.78 dimension at the top center of the drawing. It is off to the left a little and almost looks like a rectangle. I tried your suggestions with the settings for both the part and drawing files, and moving the sliders, to no avail.
        
        It makes sense what you said about the surfaces overlapping each other, and that having something to do with it, but I do not know enough about the model to make an intelligent decision on how to go about making this splash of color go away in my drawing file.
        
        Thank you,
        
        Barbara
        Like • Show 0 Likes0
        Actions
        Paul Salvador @ Barbara Blanc on Apr 5, 2018 2:33 PM
        Mark Correct
        Correct Answer
        Hey Barbara,.. the splash of color is most likely a tessellation issue, and like Dan, I don't see it either,.. it maybe how your graphics card is resolving the smoothness? Honestly, your smoothness settings are much higher than what I'd normally use.. but, when I do see what you are seeing, I increase the resolution in the part,... so, you may have to max out the Image Quality (deviation ~.019" in the RED) for the print? (my graphics shows you issue @ ~.04" deviation)
        
        BTW,... curious, do a "Ctrl-Q" (this is a forced rebuild and will take a while to rebuild) this will also reset your tessellation... what happens?
        Like • Show 1 Like1
        Actions
        Barbara Blanc @ Paul Salvador on Apr 5, 2018 3:26 PM
        Mark Correct
        Correct Answer
        Hello Paul,
        
        You guys are great.
        
        I am so glad that I came here. You have helped me out so much.
        You were right. I maxed out my image quality, rebuilt the model and then nothing happened. I did the ctrl-Q, and nothing happened.
        It wasn't until I saved the file, and then came back into it, that the splash of color went away.
        
        Thank you so much.
        
        Barbara
        Like • Show 3 Likes3
        Actions

Help! Have a complex curve part that I want to hide part of, and it won't let me make a dwg.

Attachments

Outcomes

Attachments

Attachments

Attachments

Attachments

Related Content

Recommended Content