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weld beads, can they be attached to sketches?

Question asked by Jim Steinmeyer on Feb 16, 2018
Latest reply on Feb 16, 2018 by David Matula

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I have been cruising here looking for more information of weld beads and not finding the answers I need. I generally prefer to just use weld symbols but most of our welders either don't look at them nor know what they mean so the beads and caterpillars would convey the meaning more clearly.

I have a weldment (not a SW weldment) that utilizes tabs and slots along with a lot of skip welds. Picking the two adjoining surfaces has the problem that the bead stops at the edge of the slot while I want the bead to cover the slot and extend past on both ends. Then I had the bright idea that maybe I could create an assembly sketch that would place the locations of the beads with lines on the sketch. This would also allow for me to get the correct center to center distances on the skip welds. I have looked through the help files but have found no reference to using sketches so I assume it can't be done but just thought I would give it one last chance and see if anyone has attempted this or has a better work around.

Thank you

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Elmar Klammer Feb 16, 2018 10:13 AM
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Hi Jim,

Cruising for information is not the only thing you will do. Next comes the hurt for using weld beads & fillet beads.
I would be interest to know what makes you use them in the first place. Or any other user that has good experience with them.
Please share your experience & the solution applied.

Thanks,

Elmar
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- Jim Steinmeyer @ Elmar Klammer on Feb 16, 2018 10:35 AM
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  Elmar
  I would expect that my experience has been similar to yours from your statement. Going all the way back to 2000 I have taken a stick and poked at weld beads hoping that someday they will be usable. So far that has not been the case. I keep hoping though.
  As far as why, like I said, most of our welders can't read weld symbols anyway. I know, I know, education is valuable, but we don't seem to believe that around here.
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Dennis Bacon Feb 16, 2018 10:38 AM
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Jim,, This was done at the part level. Do you need to do it in an assembly?.. You can see the sketches that the bead is attached to. This is a slot and tab. I just ran the bead the entire length.
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- Jim Steinmeyer @ Dennis Bacon on Feb 16, 2018 10:57 AM
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  Dennis Bacon wrote:
  
  Jim,, This was done at the part level. Do you need to do it in an assembly?.. You can see the sketches that the bead is attached to. This is a slot and tab. I just ran the bead the entire length.
  
  Here is what I working on. I could probably do it in the parts but I would have to be referring back to the assembly frequently to get it right. Unless I created a sketch on the back sheet, hum that presents an idea....
  
  How did you select the sketch? I assumed it would be by using Weld Path but when I select that in the manager the sketch disapears and selecting in the tree does nothing.
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  - Dennis Bacon @ Jim Steinmeyer on Feb 16, 2018 11:10 AM
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    Yes, I selected weld path and then the sketch from the tree. This was done in an assembly.
    Edit:.. I did notice that you have to have just one sketch path per bead.. So in order to do your skip welding you would have to have one line per sketch per bead.
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    - Jim Steinmeyer @ Dennis Bacon on Feb 16, 2018 11:13 AM
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      interesting, it will not allow me to select the sketch. Maybe it needs to be in the part level rather than the assembly?
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      - Dennis Bacon @ Jim Steinmeyer on Feb 16, 2018 11:19 AM
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        I don't think that's it Jim. What I did above was at the assembly level but like I said, if you have more than one path per sketch it doesn't seem to want to select it.
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        Jim Steinmeyer @ Dennis Bacon on Feb 16, 2018 11:33 AM
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        Dennis Bacon wrote:
        
        I don't think that's it Jim. What I did above was at the assembly level but like I said, if you have more than one path per sketch it doesn't seem to want to select it.
        
        Ah, I missed that tag at the bottom. That would be it. It also makes this a whole more time consuming.
        
        Thank you for your input.
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        Dan Pihlaja @ Jim Steinmeyer on Feb 16, 2018 2:58 PM
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        Jim Steinmeyer wrote:
        
        Dennis Bacon wrote:
        
        I don't think that's it Jim. What I did above was at the assembly level but like I said, if you have more than one path per sketch it doesn't seem to want to select it.
        
        Ah, I missed that tag at the bottom. That would be it. It also makes this a whole more time consuming.
        
        Thank you for your input.
        Create your main (skeleton) weld path sketch.
        Then create a sketch and convert entities for the first path
        Then create a sketch and convert entities for the second path
        Then create a sketch and convert entities for the third path
        repeat....
        
        I know it is still time consuming....but it might sane you some time editing it in the future.
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        Jim Steinmeyer @ Dan Pihlaja on Feb 16, 2018 3:39 PM
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        Yes that is how I would do it too.
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David Matula Feb 16, 2018 4:20 PM
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why not just make a simple model of a fillet weld. add a few configurations for different lengths and them mate that weld bead part in the assembly and then use a linear pattern to make it go the length that you are looking for. For a skip weld you should be able to skip instances of the pattern.
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- Jim Steinmeyer @ David Matula on Feb 16, 2018 4:23 PM
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  You know, that might be the best and fastest way to make this mess work.
  
  If you ain't cheating you ain't trying.
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  - David Matula @ Jim Steinmeyer on Feb 16, 2018 4:47 PM
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    sry I did not see this sooner in the day...
    been trying to find out where to get reviews on different vars.....
    lots of suggestions but no place to get the infor for personal review.
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weld beads, can they be attached to sketches?

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