What is the way to have different Global Variable values for each configuration? Because even though I gave a different Global Variable values for each configuration, it took up the default configuration values.
A window pop-ups but it has two separate question with one answer.
Yes I want to save changes to the current configuration but I do not want to switch to another configuration.
Maha,
To change the value for a Global Variable in different configurations, you need to tell SolidWorks that is what you want.
Right now you have told SolidWorks you want the same number for ALL configurations.
So, just select a different choice from the drop-down.
Thanks
When i try this solution i have no drop down to select which configurations to apply to, just an increment-decrement bar. Does this need to be enabled or only apply to certain versions of SW, I'm trying in SW2015. I don't get a drop down for derived or standard configurations.
That's how it looks if you only have 1 configuration. If you go to your Config tab and add another configuration and then go back to that dialog you will be able to access the configuration menu:
I do have multiple configurations, I've been trying both derived and independent and it's still not popping up. I don't know if there's another setting that has to be managed as well.
Interesting...I was sure that was it. I guess I was wrong. It is probably a setting buried somewhere. I lost the ability to keep children if I delete a parent. I must have checked the "don't show this message again" box and can't find the fix for that one (which seems much clearer than your problem). So, I have no idea where under Options your setting is different than mine.
Sorry I couldn't help.
Michael Baycura wrote:
I do have multiple configurations, I've been trying both derived and independent and it's still not popping up. I don't know if there's another setting that has to be managed as well.
What version of Solidworks are you using? This was new for SW 2014.
No problem Matt, thanks for the suggestion. Dan, I'm using SW2015 and I think there is something about just this particular part as I was able to build a different test part from scratch with a simple feature and I got the drop downs. The problem part is rather complicated with a web of relationships and equations, so I'm guessing there may be some failure in those interactions that is causing SW to disable the global Var config drop-down. If I find the problem I'll post what it was.
If you can, post the assembly up here, and maybe someone can help you get to the bottom of it. Also, send it off to your VAR, if you are on subscription.
I also couldn't see the configurations drop-down in Equations. I couldn't fix it, but I found a limited work around that solved my problem, maybe it'll be useful to someone else.
I selected the sketch dimension I want to control, clicked the "Configurations" button, then selected "This configuration". That let me switch configurations and change that dimension in the sketch. I tried using a global dimension, but that still wouldn't change between configurations. This may not be great if you have a lot of dimensions to control or complicated equations, but it worked well in this limited capacity.
Instead of configuration of GV, create Specific Property, set the value of Specific Property for each configuration (you can use Design Table) and link it to GV.
Thanks
I've taken Matt's suggestion and sent the problem part into a subscription help rep and he has sent the bug up the chain.
According to the reply i got, there is no fix for a part in SW2015 that has lost it's configuration drop-down menu in the equation manager using SW 2015 or SW2016.
There are however two ways to get the config drop-down in the eq. manager in SW2015-SP5 part if it's not there.
1. Redo the part, create the configurations at the start before creating equations, then when creating an equation set a configuration to different value (may not be necessary, but i did it to double check it was working).
2. try these steps below that the rep returned to me. I have not tried this, so I can' say that it would correct a broken part.
Using a higher SW release 2017SP5,0
Thank you Michael! I had success with getting the drop-downs options to show up by using the 2nd method within my part file. I'm using 2018 SP3.0.
I created the part equations first within the file and then added configurations later on to control just 1 global variable from the global variable list. Initially the configuration drop-down options did not show up, but after exporting equations, deleting all equations (including linked values), and importing the same equations back in, this woke SW up and allowed me to select individual config options in each global variable like I needed.
This issue still seems to be present in SW2019 SP4. I've tried deleting all the equations and re-saving the part as suggested in Michael's post (option 2), but I still only see an increments/decrement bar and cannot choose the configurations for the global variables (I have multiple configurations). I have other parts where this is working fine, so not sure why this is a problem with just this part. While I can configure these global variables per configuration with a design table, I need to also have these driven by references to assembly parameters and using a design table prevents me from being to make this reference. Also, the design table hinders performance and adds unnecessary bloat. I will try SW 2020 beta 3 to see if it is fixed there.
Issue persists in Solidworks 2020 Beta 3. At least, as far as I can tell it is not possible to fix a part that has this issue in this version.
In fact I have forgotten the issue I have to revisit and very matter.
I had the problem of the configuration drop-down menu not showing up.
But when I select a value to change it the drop-down appears, and I'm able to choose configurations. I'm using a 2019 student version. I don't know if this is the case for other versions.
File?
If you click the particular raw once drop down menu appears.
Maha,
To change the value for a Global Variable in different configurations, you need to tell SolidWorks that is what you want.
Right now you have told SolidWorks you want the same number for ALL configurations.
So, just select a different choice from the drop-down.