Liebe User, Liebe Experten.
Ich frage mich nun schon seit langem, wie ich ein Lochmuster mit unterschiedlichen, gesteuerten Durchmessern anlege, wie einem Verlauf zum Beispiel?
Im Anhang habe ich ein Beispiel eingefügt.
Danke an Alle!
Leom
Dear users, dear experts.
I asked myself, now for several times, how do I make a hole pattern with different hole diameters, aligned, coordinated by a gradient for example?
In the attachment I send a picture as an example.
Thank you all!
Leon
Thanks, Krzysztof. Nice Tutorial, this helps a lot.
Hi Lucian
In SW there are many ways to achieve the same result, but there are always pro's and con's. Here is a versatile method that I use. It takes a bit of head scratching at first but it's qiute simple really.
The basis is to use a 3DSketch to define the hole. The hole itself is on the Top Plane, but an extra line running along Y is coincident with a surface at one end.
I applied an equal relation to both construction lines, this has the effect of the hole becoming the same diameter as the normal distance to a point on the surface directly above the hole center.
So the surface controls the hole diameter. I created the surface like this so that the diameter grows from 5 to 10 mm.
The final stage is to use a pattern, with vary sketch option.
For a half stepped pattern you would have to use more than one sketch and pattern, but the same principle would apply.
Again there are many ways to apply this method, this is just a simple illustration, I hope it helps..
2016 file attached
That is ingenious Rob!
Rob Edwards - That Has to be posted here - What are your most impressive tricks of solidworks, Please spread.
This is a perfect example of a Demigod Power User - Alin Vargatu
I think Rob Edwards would probably introduce room temperature fusion like this:
"Here is something that I do, works pretty good, no biggie."
While the rest of us just look on in shock and try to figure out what just happened.
wow, just wow - nicely done!
Thanks Guys, but I can't take any credit, the technique is described in Matt Lombards most excellent Solidworks Bible - an absolute must read for anyone I reckon.
On way home I thought of this.. Used a Dome feature to create the surface
Hi.
I don't have access to solidworks right now, but i found small tutorial on youtube: SolidWorks Tutorials - Modeling with Patterns - the Instance to Vary Option - YouTube