Thicken side 2 is working but Thicken side 1 and Thicken Both Side is producing error result. What is the reason for that?
Definitely weird, mid will work up to around .75mm, unidirectional will work either way up to around .95mm
I'm sure there is a valid reason, I just don't have an answer for you right now . . .
..apply tangent conditions between your sketch (sketch10, 3dsketch3) and surfaces (surface loft1, mirror4)
Further to what Paul said, turn on Zebra Stripes (under Evaluate) to see how surfaces are meeting. When surfaces are tangent, the stripes are continuous.
Good point !
Also it also tell you how smooth the surface is
I assume that you want to make these two surfaces tangent but in my case these two surfaces should not be tangent.
Here is the cause of the error you got - a gap when thickening side 1 the part which needs to be fixed
This picture shows the gap very clearly but I am trying to find out how you fixed it.
Did you read all the replies
1) When 2 surfaces don't have a good connection, it'd create a gap when thickening
2) when you apply mirror feature to surface, make sure it's normal to the plane
3) when you use loft feature to connect surfaces, make sure use end constrain to create a good connection
Then you won't get error thickening either side
A knit surface how can create a gap when thicken.
..ok,.. then you need to "help" solidworks out with this,.. that is, help it understand you need to "maintain and extend" those corners... when working with surfaces,.. always think like a "seamstress" always account for extra "fabric" material for the boundaries be sewn together.
..there are a couple was to do this but you want to offset just the surfaces...
so, you would create boundaries or patches at the 4 corners (images attached)
..and sew or knit them... then, thicken.
Your concept and Dennis Bacon concept is same both are concentrating on corner relieve. But in one method design change is visible in the other it is not much visible.
There is no corner relief.. I only added boundary surfaces to your corners.. the knit then helps solidworks to preserve that knitted corner as best as possible... with out the boundary,.. the corner tears/rips apart.
I mean it is corners giving trouble therefore treating it in a different way.
You got the errors because the way you loft which result a gap between the surfaces when you thicken it
I fixed the loft and now you can thicken on both ways
Make sure the surface is normal to the profile so when you mirror it, both are symetrical
FYI Maha,,, There are no issues with your model if you relieve your surface in these area. I thickened this to 4mm in both directions. If I had made my reliefs a bit larger I could have gone more.
Thanks for the explanation.
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