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This is what is in the dimension text box
(I had to take out a couple< so the browser would not format the text)
So to make this read right I just change the .053 to .100
But why does it read .053 in the first place?
Because that's the depth of the full hole that you are calling out. There isn't an easy way to get this to be parametric (that I know of). You could try an offset cut-extrude to the depth that you want. Not sure if that will work or not.
Yes, you may have to dim this from a paralell plane or datum. Your sketch is offset from the part ~0.047
If you created the spotface using an extruded circle, a "simple hole", or the legacy hole type in the hole wizard, the hole callout tool tries to figure out the hole dimensions by using the part geometry instead of extracting values from the feature parameters (dimensions). This drove me nuts for years.
Try using one of the other hole wizard holes, like the simple drill sizes, or screw clearance. Scroll down to "custom sizing" and set the drill point angle to 180°. I just tested this in '07 and it gives the correct depth on a drawing.
The main drawback to this method is that you will need to create a reference plane on the side of the cylinder, or get used to using 3DSketches to locate holes. If I had to do this many, I'd probably create a library part to streamline the whole process. It'll take some time to set up, but you'll have a robust link between the hole callout and the actual hole feature on all the drawings. Another drawback is that the note will use "Ø" instead of the spotface symbol unless you go mess around with calloutformat.txt.
Hope that helps.
P.S. Who knows how to get <"HOLE-DIAM"> and <"HOLE-SPOT"> to show correctly here on the forum? It's apparently trying to read whatever is in the <> as html.
Thanks so much for the post.
Using the hole wizard solved my problem, and the parallel plane already exists on most of these parts so that won't be a problem. Appreciate the insight.