I was wondering if its possible to hide all nuts and bolts at once in an assembly. I am trying to do an exploded view without the nuts and bolts.
If you are using Toolbox components to go to select --> select toolbox.
This wills select all toolbox components in assembly. Then hide/suppress them.. all at once.
I categorize my components in folders then to hide a group select the folder and hide.
I Use that, it's very usefull to make differents states of tooling.
Alan Bumbaugh I too place all my hardware in at least one folder, sometimes I'll do an SAE folder and a Metric folder, it really cleans-up the tree, and if you use design tables, all you need to do is supress/unsupress the folder(s), a great time saver! Bravo!
Yes it is entirely possible in a few different ways. first, if you are using ToolBox to generate your fasteners they will have a different icon in the tree indicating "Is Fastener". We don't use toolbox so I have no experience but I have seen comments about being able to run a Macro to select and hide all fasteners. Again, not being familiar with the toolbox, I have heard that it is possible to give non-toolbox items the "Is Fastener" designation. If you don't have or don't want to create a macro you can easily see the fasteners to hide.
What we do here is to group all of the fasteners in a folder in the tree so that it is cleaner. Then is is very simple to hide everything in the folder. Another thing that might be a good idea is to suppress everything in the fastener folder. As long as this doesn't create mating errors this will make things faster without the fasteners in the model.
I guess this is what i was referring to about the toolbox parts and not having used them. This is a very nice option and would maybe worth looking at toolbox again for. But then what to do with all of the assemblies that have been created without toolbox parts over the last 20 years.......
Hi Jim Steinmeyer ,
I usually use Toolbox components. Easy and convenient for my applications.
When I receive files that were created without toolbox components (those pack and gos especially) I filter them in FM. For example when I type "SCR," it'll filter all components that start with "SCR," for screws and "Washer" for "Washers". I select them all and put inside a folder. then hide/suppress them. Very manual but works for me. As you suggested using macro will be more convenient.
To add to Sachin's post, you can even type in "Toolbox" or just "Too" into the search bar in the tree to filter out Toolbox components
You could use the "Advanced Select" option at the bottom of Sachin Malenahalli Murigesh image he posted & create your own set of rules for search items. I often find it handy to have multiple conditions & be able to use the AND, OR & NOT (plus others) commands.
These are awesome suggestions! (Some I already use, some I didn't know about, some I use a little differently.)
I would throw in a suggestion to create a display state if you toggle visibility of hardware very often.
thanks for all of the ideas!
To add to the discussion:
We add the "IsFastener" property to all of our fasteners (both generic and specialty) in our Library. Then we are able to do a search on that property to isolate all fasteners in all sub-assemblies and hide them using a Display State.
The main reason we do it is to simplify sub-assemblies used in a top level assembly where the presence of small details like fasteners causes performance problems - especially in Large Assembly Drawings. Upon opening the top level assembly, hidden components can be excluded from being loaded into memory.
This method works well at any assembly level - no special configuration is required of the sub-asms. No use of "supression" is required. That means no modification of read only documents in a PDM environment. This method finds ALL fasteners - in folders or not, in patterns, in mirrored features ........
That Custom Property can be added to any file. There are macros out there that will add any property to multiple files in one operation. So even if you have fastener files that date back to the beginning of SWx, you can still apply these techniques.
We do not use Toolbox. We have developed our own extensive read only library of generic and specialty commercial parts that are available to all users.
I Agree, better perfomance is on custom fasteners.
Is the "Is Fastener" just a custom property then? So if I simply add the property to all my hardware with a "yes" value they would show with the fastener icon? That would be a start.
The other issue I have had is that I have been unable to make smart fasteners out of what we have and I find that would be very helpful even though I usually just use the "copy with mates" system now.
Yes, we use the property "IsFastener" (no space, and I believe that it is case sensitive), Type is "Number" and the Value is "1". It does not display in the FM with a fastener icon; that may be a different property.
It is not a Smart Fastener in the sense that Toolbox parts are, but we can switch configs (lengths) very easily. We also use a consistent Mate Reference definition for all our fasteners, which makes it very easy to add the first instance to an asm.
I have attached a sample fastener. I needed to remove a lot of info to keep this simple, such as most of the configs, the Design Table, and some proprietary Custom Properties.
I hope you find this useful.
Thank you I will give it a look and see if we can incorporate some if the ideas.
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