I want to make boss extrude 2 a different part for easier molding. How do I do that?
I want to make boss extrude 2 a different part for easier molding. How do I do that?
I don't see the insert into new part. I have seen it before when making molds.
It says it can't copy it to the clipboard.
I tried also just copying the sketch and extruding it again, but I need to extrude it to the surface of the mailbox. I couldn't find out how to do an extruded boss in an assembly.
Can you please share some pictures, as we can't able to open the file
Thanks
Naga Ranjithkumar A
You can't do an extruded boss in an assembly. In general, assembly operations are of the "remove material" type (with the exception of the fillet and weld operations).
If you edit the part you want to add the boss to in context (search for that in your help files), you can then add the edges/surfaces from the surface of the mailbox (think offset surface --> 0" offset), then open your boss part separately and use those surfaces for your extrude.
That being said, if you keep relations, then make sure that the boss part is always below the mailbox part in the assembly tree.
Looks like Dan and I are in sync, but his boss didn't walk in while he was typing his response.
Eric Eubanks wrote:
I couldn't find out how to do an extruded boss in an assembly.
This is not possible. Think of how an assembly actually works, parts are brought together, but new material is not added to any part. In an assembly you can remove material, but not add it.. As far as removing material goes think of it as mate-drilling several parts. You clamp them together and then drill through the several parts. The drilled hole is not on the part files because it doesn't exist until the assembly.
Instead of trying to add material in the assembly, which you cannot do anyway, perhaps you should modify one of the parts to add to its material. Look in the Help for In-Context Editing or Editing a Part in an Assembly to learn more.
Eric Eubanks wrote:
I don't see the insert into new part. I have seen it before when making molds.
Are you attempting this at the assembly level? If so, then that won't work.
It says it can't copy it to the clipboard.
Same question as above.
I tried also just copying the sketch and extruding it again, but I need to extrude it to the surface of the mailbox. I couldn't find out how to do an extruded boss in an assembly.
Is it a separate body, or just a separate feature? (I can't open your file because of newer version).
If it is a separate feature, then you can copy/paste some features.
Just select the feature, hit CTRL C. Then go to the new part and select the same type of feature that it started from (like a planar surface) and hit CTRL V.
You will have to fix any external connections (like positioning it to the part).
If it is a body, then if you want a link from the new part to the original part, then open your Solid Bodies folder in your tree and RMB on the body and select "Insert into New Part..."
If you simply want to MOVE the body and delete it from the original....well, the only way I know to do that would be to basically do it the same way as above, but then break the reference to it, which will turn it into a "dummy" solid in the new part. If that is not what you want, then you might be better off doing a "save as" and remaking the new part.