I want to mirror this entire body but mirror to body is not detecting the body. What is the reason?
Solid Air is correct. When using sheet metal the cut created by the split function is not recognized as a valid surface for mirroring. A cut-extrude with the normal options is a valid surface to use.
I did not know this was a limitation but SolidWorks does not like the split feature. When I delete that, the mirror works.
If the Front Plane is not selected as the mirror, the body can be selected.
Planes cannot be used as the mirror element for sheet metal parts. Only faces of sheet metal parts can be used. I have no idea why that limititation exists.
I also have no idea why the faces created by the Split feature cannot be used.
Review the attached part for a different way to create the part.
Its a bug in SolidWorks that will not let you select the plane. Select the face, select the body then finish the mirror. Now edit the mirror feature then replace the face with the plane for the Mirror Face/Plane selection and SolidWorks completes the mirror. At least that works in SW2016
Sorry I am unable to open your file.
Please see this video
Solidworks Basic Tutorial - Lesson 5.6 - Sheet Metal: Jog - YouTube
I use 2016-2017 student edition.
Learned something new today about mirroring. The difference between what you did and the U-Tube video is you selected consume bodies in the split feature so the one split half was automatically deleted. What the presenter did was not consume bodies then deleted the body as a separate feature. If you do it the same way then SW will allow you to select the plane and body to complete the mirror.
I noticed the same thing Solid,, So I tried it (deleting body instead of consuming) but wasn't successful then either.. I take it you were.. I'll have to try that again.
I noticed in the video he is using 2012 Premium.. I think that may have something to do with it. I noticed that when when I used 2014 I was able to use the face to mirror but not the plane. In 2016 I wasn't able to use the face or plane. There are some things that just worked better in 2012 (earlier versions). I suspect there is a good reason for it???
Yes I was successful using the plane and not the face in SW2016.
Sheet metal was revamped in SW2013 which changed a whole lot of functionality which is probably why you see the differences in the earlier versions.
Edit: The way I got it to work was not to check merge solids, then edit the mirror feature and check merge solids. Another solid quirk.
Retrieving data ...