So I have asked this question like 4 times now and still have no answers why do fillets never work? What can I do different to make sure they will work? Just trying to put a 20mm Radius around the top of the sharp corner.
Are you talking about this radius?
You can do a face blend
Not sure what you mean by face blend
cause my face fillet does not work
Face fillet - select all of the bottom faces (perimeter) as one selection set, then the planar surface as your second set.
Regular fillet - RMB an edge and "select loop"
Thank you For your help
How come mine does not work I use 2015
Part has to be reformatted from igs.
SW is not able to heal all gaps between faces after reformatting:
Model your part in SW and everything will be fine.
Travis.. could I please suggest you export your data to yourself and others using SolidWorks as native Parasolid (no translation, the native kernel for SolidWorks) and not iges (old translation)...
...attached parasolid (repair of iges) and sldprt w/ R20..
I was not able to add the radius,
Here is what is wrong with your part.
first you have to fix this area I deleted,tangent fill this face
This is the other area that is causing the problems.
Use the face trim tool to trim off this side of the part,
add radius and mirror the body.
hope this helps
PS or you can do what Craig Schultz did, it works
Good thing is you got answers from some experts here - I'm just wondering if you can't apply the fillet feature to your model, why don't you try diff. approach but decided to waste lot of time to fight with it?
I'm curious as to what format the original file is. Obviously something has been lost in the translations of that file to the iges. As Paul Salvador mentioned the parasolid would probably make for a much better translation. If you modeled this in SW I suspect you did not knit your surfaces therefore making it impossible to fillet. In my file I fixed up the surfaces (probably similar to what Paul did), knitted then filleted without problems. Since I don't know what your exact dims should be I had to work from your broken surfaces and I'm quite certain that it doesn't match your intended surfaces exactly. If you did indeed model this in SW and knitted you will not have any problems at all. Must admit that I probably did a few more steps than what Paul did. He has a much better understanding than I do in regards to surfacing.
Edit:.. Well, JOHN GEORGE made me look a little silly with the impossible comment. Curious,, is your native file a solid?
Hey Dennis.. I like what you showed..
for me, and becuz Travis wants to preserved his clients data... I just imported, repaired and manually fixed that top radii.. them exported as parasolid.. and reimported and added the R20.
..and if I were to do what you did.. I'd do it about the same.. but use the top edge and extrude.. copy the usable faces and untrim.. face blend the top R5 and the bottom R20..
Ahhh,,, the old export and re-import trick. Not understanding the preserving clients data thing quite yet. Did what you do fix the sides and top just by doing the parasolid back to SW?
Dennis,.. like you,.. I do not fully understand the preserving aspect because I know if my manually repaired data is within tolerance or matching.. it's good to go,.. or, if needed, I request the model be veriftied or repaired by the customer.
The export/import trick.. well, in this case.. the seams were sewn up after repairing the top corner fillet or before exporting.. I just wanted to get back to a clean model.
And, agree... it would be best to have the original model before the IGES or any mods were made to understand why the seams opened?
Retrieving data ...