Hey everyone,
I created a plastic housing use a multi-body part file (master file). I saved out each individual part file using "Insert into New Part", and then added engineering details into each of these parts. Lastly I created an assembly from these parts.
After getting pretty far into the process, I realized there was an issue with my housing design. I went back into the master file and made some pretty major changes. I ended up splitting one of the bodies into multiple smaller bodies. After finishing these changes, I went back to the individual part files and got the error: "The base part has no solid".
I want to reattached my part files to their corresponding bodies in the master file. I listed external references in the individual part file and it points back to the master file. So it seems like the unique body ID in the master file changed, causing all of the individual part files to lose their references.
I know if I had used the "save bodies" command, I could open up that command and point it back to the correct body in the master file. Is there a way to do this using the insert into new part command? I'd like to avoid needing to remake all of the individual part details .
Thanks for any help!
Hi Maxwell, if you have access to the Customer Portal, you can use the Knowledge Base to research SPR 506725, this details this error message. I am guessing it is indeed because the ID of the master part body has altered and seemingly eludes to a boolean type operation. Was the split feature the only thing you did, as i have tried a very simple use case and the child part maintained the reference okay.
My thoughts are, a) future strategy is instead to have the master part modelled, and then create a new part for the child and use Insert > Part and bring the entire master model in and then delete the bodies you do not need as your first feature. It still has the external reference to the master but as you pulled in everything to start with, it should react more reliably to changes. b) Save bodies would work, but as this places a historical feature in the tree you may need to rollback, or reorder this feature to keep at the bottom of the tree, otherwise additional changes to the master that appear beneath the save bodies command won't filter down to the child parts. c) this is a bit obscure and I haven't tested this, but how about doing another "Insert into new part" from the master model with the bodies split up further. Then for your original (broken) child part, use File > Open and change its reference to the newly saved "Insert into New Part" - now I would think some downstream references would need tidying up but you may get lucky- it will also give you an extra level of references that you would have to manage (Master > New Child Part > Original Child Part) but it may work.