I have seen videos in YouTube when inscribing letters on a part not bothered to make it fully define one. Is it allowed usual practice?
Using the Text tool in sketches ALWAYS leaves it undefined. There is nothing you can do about it short of Dissolving the sketch text then fixing it in place.
Personally, I don't bother. Although it is annoying that the sketch text remains undefined.
What I do is to make sure that sketch text goes into its own separate sketch and don't mix it with other sketch geometry so that I don't get other geometry screwed up by accidentally not defining it.
IMO, A matter of preference in this case only. I always require fully defined sketches.
This is just as "dangerous" as leaving any other sketch undefined. All you would have to do in this case is add some dimensions to the points at the lower left corners of the text and it will be defined to the point it won't move on you. You might also have to dimension the length of the lines the text sits on in order to change the status to Fully Defined.
Dimension the line end points. These are about the only sketches I don't fully define. Just in case you add more characters...., I usually constrain the mid point for center justification, or the left end point for left justification.
With text - see the circled points, dimension those to lock them in, the text will remain blue and appear to show as not fully defined, but the dot will turn black and the bottom of your screen will show fully defined...
That is true John, unless you use geometry to drive the location of the text. Then that dot does not exist and it remains undefined, even though your geometry is fully defined.
That't right Dan, but you can lock in the sketch line or sketch arc. The reason for this is you can change the text justification from right, centered, left or justified etc, that would lock it to fully defined...
I wouldn't want anything floating in any sketch especially text..
Whatever you do, don't do this (OMG):
Scott, that should be: OMG!!
The ONLY reason I can fathom for dissolving sketch text is if you want to then modify some of the letters for stylizing or making a logo out of it.
No, it still lists it as undefined, even though the sketch line or sketch arc is fully defined. At least it does in SW 2015 and before.
If you dimension to the point in the sketch text like you said, then = fully defined.
If you use sketch geometry to define the location of the text, then = under defined.....NO MATTER WHAT.
There's always the FIX button, which is cheating in a way. But does keep it from being modified (sort-of).
What I am saying is that, when you use sketch geometry to locate text, it LISTS it as under defined, even though it is fully defined. So Fix is not needed....
The only way that I can get it to be fully defined after aligning text to sketch geometry is to afterwards, use the "Fully Define Sketch" function.
Which, as far as I can tell does absolutely nothing except toggle under defined to fully defined in the specific case of sketch text. No new relations are added or anything.
Edit: I want to point out that I literally just discovered this. It was ALWAYS annoying to have sketch text list as under defined....now I know what to do, even though it is an extra step.
100% dead on - however if the line or arc is defined there is no way you can move the text sketch, I guess this is where I was confused...
S. Casale - you can't "Fix" text btw - but you can fix the geometry that locks the position of the text
So, John, you are saying some things just can't be fixed? The OCD in me (it should actually be CDO (alphabetical order) and some would argue just CO, that it's not a disorder) has a problem with that concept!
I have made the dot black but still sketch is under defined. Part file is attached.
That is because you have a sketch controlling the text, see the above replies....
Just as a matter of interest, could you not use a 'block' for this type of situation? And if so, would that avoid the under defined issue?
What you mean?
I've asked the question, and I'm not sure that this would work as I've only just recently started to learn about 'blocks' myself.
BUT, with your scenario, I was thinking that if a company was going to produce quantity of say 400 of your product, they might be able to use a block for the text (that is editable) for date of manufacture and serial numbers and such and hopefully fully definable. This way, only the block gets edited (easy) and you don't have to muck around with definition, if it works!
It was just a thought. 2017 SOLIDWORKS Help - Working with Blocks in Drawings
Those that have commented above will have a better idea than me Maha.
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