Select the dimension.
Then on the left side, simply remove the first line.
Although I hope that you aren't giving this part to a novice machinist/manufacturer. Because he will likely pick the wrong tap dill size.
We specify tap drill size because that is what we need it to be. It is what determines how much thread engagement there is --> which translates to how strong of a joint it is.
If this is a safety concern I would HIGHLY advise putting in the tap drill size and NOT leaving it up to the machinist/manufacturer.
I want to make this automatically for all tap holes. I have thousands of holes to do. I don't want to do it one by one. Thanks
We remove the tap info unless it is critical to the feature. We only call-out the thread and depth. We also have a standard machining note that states taps are for reference only, and do not break thru.
Open the calloutformat.txt file in Notepad and edit it there. At the bottom of the file is a list of all the placeholder tokens that you can use.
You will need to update in more then one spot . A bit of trial and error with editing will get you what you need and familiar with how the calloutformat.txt file works. Keep a shortcut to the file out on the network and fix as you find things.
Here is my callout for a drilled and tapped thru hole from our customized calloutformat.txt file.
* drilledand tapped thru
TAP-THRU(tt)=DRILL & TAP THRU <hw-threadsize>
Once you edit your file be sure to place it on your network and path to it in the System Options > File Locations so it does not get over written when updating. Also you can path all your users to that file so everyone is consistent with the hole callouts.
^^^This is the route I took and the only way I could find to do the same type of thing.
The only thing I'll add to this comment, is always have a backup of your calloutformat.txt file. If you mess it up, it's sometimes easier to just start from the backup.
I also always remove the tap drill size. It should not be on the drawing. It's up to the machinist to use the correct size.
I only call it out if the design is needed.
SW should have the option to remove it.
Create a Hole Wizard Favorite....
How do you eliminate the drilled hole size when you create the hole wizard favorite?
I thought maybe a legacy hole but I don't see any provision for a tapped hole.
Who's in favor of keeping Drill line in threaded hole callouts? Who's in favor of removing Drill info from thread callouts? If thread removal is preferred, do you want an option for "DO NOT BREAK THRU" or does these even provide too much info for the average hole?
Why not have the ability to have the callout either way?
"DO NOT BREAK THRU" is fine as long as it is an option .
Ditto... I was just in the middle of typing a response when Tony got the point out first.
Just the other day, I was apologizing in another thread to some people because I really wanted the hover over mid-point to grab the midpoint for lines and edges. I advocated for that functionality on the forums and voted for it. Even though I personally love the new functionality, apparently it has been causing some people a lot of trouble. So, I definitely agree with Tony, always give people the option if possible..
I'm for the option of removing the drill info, and having the option "DO NOT BREAK THRU".
I've run into more companies that don't show the tap drill than do. I vote to remove.
I think what a lot of folks struggle with is how to edit the holecallout file and then across the company using network locations.
A checkbox to add/remove tap callout from the hole wizard would be nice. I don't care about the do not break thru as it's standard for our drawing notes.
I would like the advanced hole to be worked on considering it was offered as a really nice new hole creation feature. Perhaps make it work with hole call-outs on drawings?
I've been holding my tongue on this one, but S. Casale you are correct. The solution to this is to have an interface to the calloutformat.txt file or have it's functionality embedded into an interface. Why in 2017 are we editing text files to control functionality in a multi-thousand dollar program? However, I wasn't going to suggest it because I believe to do it correctly would be take a lot of resources, and I'd like the focus to remain on ONE and TWO.
I typically edit out the drill info, also. Same for reamed holes and counterbores.
My simple notes state only what size tap and quantity, i.e. "4X 3/8-16 TAP". The toolmaker knows what to do.
My notes will also say something like "4X DR. & C'BORE FOR 3/8 SHCS".
As always, there are exceptions such as a specific c'bore depth for a shoulder bolt or for die life.
Taps for shoulder bolts are noted as such "4X 3/8-16 TAP FOR 1/2" SHL'D. BOLT" so they know not to countersink too deep.
In instances where they should NOT drill through, my note would read "4X 3/8-16 TAP DO NOT DRILL THRU".
Dowel notes only say what size dowel and whether its press fit or slip fit, "2X <DIA SYMBOL>.3750 PF FOR DWL."
As mentioned in other posts, I would like the option of relief drilling a hole. In a situation like this, my note would read:
"2X <DIA SYMBOL>.3750 SF FOR DWL. RELIEVE TO SUIT". The toolmaker knows to leave 2X the diameter at the bottom of the hole.
In my opinion, it would be great to have an editable drop-down list of text that I can append to a note and the choice to omit drill information.
Similar to the choices to add symbols to your notes, but text.
I realize this isn't ANSI standard, but I my 40+ years in the trade, notes like above are all we've ever used. As they say, K.I.S.S.