2 Replies Latest reply on Dec 1, 2008 2:35 AM by Gerry Roston

    Newbie question: setting up basic template

    Gerry Roston
      All,

      Based on some reading here, it sounds like drawings are a source of frustration. As such, my apologies if my seemingly easy questions are sore points.

      I would like to have a simple template for drawings. Obviously, I would like the text in the default dimension box (e.g., two decimal place +/-) to have numeric values where needed. It would also be nice if the initials of the person who drew the drawing and the last file save date to be automatically inserted where needed. How can this be done? (The book I have doesn't mention this and the on-line help is not too useful.)

      Can title be changed to the file name and Dwg No be a text entry field?

      Also, for adding text to the title block, is there a better way that Annotation->Note? It would seem that clicking in the field should enable text entry with all formatting properties set properly.

      Thanks for your help.
        • Newbie question: setting up basic template
          Ola Linde
          This will be rather long but here we go...

          1. Open SolidWorks, make sure you have no parts, assy open. You should have a blank SW.
          2. Create a new drawing, chose a frame that you want from provided templates.
          3. Go to option and the tab "Document properties". All settings on this tab is unique for this file. So if you want to allways have two decimals, select Units, select your unit system and number of decimals in the table. Here you can select that a Length dimension should have two decimals (.12) and an Angle dim one decimal (.1)
          4. When all settings are done, click File - Save as. In the Save as type field change to Drawing template, chose a nice name, ie. GerryTenplate.drwdot.

          Now you have a document file template. Next step is to adjust the sheet itself.

          5. Right-click in the drawing area and chose "Edit sheet format".
          6. Zoom in the title header.
          7. As you can see there a some coding, ie. $PRP:"SW-File Name". All these are ordinary notes that with correct coding collect properties from the drawing file. If you instead insert a note where you write $PRP:"SW-Author" it will collect the info from the properties found under File - Properties - Author. Here is a list of some more examples:

          SW-Author = Author field in Summary Information dialog box
          SW-Comments = Comments field in Summary Information dialog box
          SW-Configuration Name - Configuration name in ConfigurationManager
          SW-File Name = document name, no extension
          SW-Folder Name = document folder with backslash at the end
          SW-Keywords = Keywords field in Summary Information dialog box
          SW-Last Saved By = Last Saved By field in Summary Information dialog box
          SW-Subject = Subject field in Summary Information dialog box
          SW-Title = Title field in Summary Information dialog box

          8. When you have fixed your title header, right-click in the drawing area and chose "Edit sheet" to return to non-editing mode.
          9. Click File - Save Sheet Format, chose a file name, ie. Gerry-A-landscape.slddrt.
          10. You are done!

          Next time you want to make a drawing simply select your own templates.



          Some remarks that are good to know about:

          A. Make a backup copy of your own templates since they will disappear during upgrade of SolidWorks (unless you save as under B).

          B. You could chose to save all private templates in a folder of your own (=outside of SolidWorks main folders), ie. on your network so everyone can use the same templates. In order for each computer to find these templates you need to change the Options - File locations and Add your network paths.

          C. You can create how many templates you want. One sheet format for each size, as well as portrait-landscape versions. Maybe you need some templates in metric sytem others in inch, maybe some where your customers logotype is inserted etc.

          D. You can create your own properties in File - Properties and they can then be used in your drawing. Maybe you would like to have a custom property for Project (which actually already exist as a selection in drop-down list). If so then just add that property and refer from the sheet format back to this property.

          E. With SW2009 you can make a Manager tab where your necessary properties can be selected without the pain to go via File - Properties. I still have not installed SW2009 yet (was waiting for SP1.0 which now is available) but if you need help how to make this tab I guess our fellow forum members can provide instructions.

          Good luck with creating your drawing template.
          • Newbie question: setting up basic template
            Gerry Roston
            Ola,

            Thanks - will try this out tomorrow.