Hi, I was wondering what is the correct way to build the metal part attached using the Sheet Metal feature. I also attached what I attempted. After the extruded cut, when I "unsupress" the flat pattern feature, the cuts made also disappear. So I was just wondering what is the right order to be doing things
thanks!
thanks to everyone. I am trying the unfold feature on another piece to check the feature out and it doesn't seem to be working
First UNFOLD (it will become flat)
ad your cutout
then FOLD.
Try it, I have used it multiple times.
Leszek
oops, you are right. I was trying out fold instead of unfold
I have attached a file with the method that Leszek outlined.
is there a way to change the angle from the sketch for the base flange feature from 134.5 to 135, without running into any problems?
Yes go ahead and do it
Yes,,, you can change that to anything you like within reason. In the file I sent you I copied and blocked your sketch in order to place it between the unfold and fold for simplicities sake. I was lazy... As a result the block is attached to one side of your part. This is not ideal since when you change the angle of the bend the resultant flat pattern width will change and can cause problems. Redo your sketch and make sure there is a relation to the part edges for each side respectfully like you had it originally. Don't use my block.
Continuing on from your part I made this.
So at this point, if i wanted to change the angle or the two lengths from the 'Base Flange' features sketch, I would have to redo the sketches for the cuts?
Yes. I have attached another file. In this file I exploded the sketch I added and dimensioned/added relations in order to fully define it. I also fully defined sketch19. I left sketch alone. I would recommend you fully define it also. You don't want to see any blue sketch entities. Just make sure your dimensions and relations are tied into position from the flange edges. That way you can change the bend angle and flange lengths without causing any problems. You have done a nice job on this but you did much more work than was necessary. Check out (investigate) the "Straight Slot" and "Hole Wizard" tools for future use.
I also deleted your original cut extrude and sketch that was placed after the Flat-Pattern.
Use the unfold feature, add your cat to a "flat" part, then use the fold.
It will add two extra operations in your design tree only for the purpose of designing. and you will see the results on your folded model.
Leszek