How can create and set a forming tool to result something like this????
As library feature i succeed but as foorming tool i don't know how to do it...
I would doubt if you can easily achieve this via forming tool as forming tool are meant to bulge out the material and not remove it completely.
but it's completely!
Deepak is correct (of course) about the bulging. You can slice off the bulge with a cut extrude however.
I'm not sure about you material thickness for this so I made mine 1.5mm for this example.
This is what the form tool looks like:
This is what the part looks like:
I sliced the bulge off of one:
Make sure the library or sub folder you pulling it from has the Forming Tools Folder selected. Then the library feature becomes a drag and drop on your part.
Even if you don't keep it in forming tool folder, you can still drag drop it. The issue Hrituc Alexandru is facing is related to PunchID not showing/working for library feature.
Hrituc Alexandru I think you can use the approach suggested by Dennis Bacon and shave off the bulging.
Since this has a dimension for the cylindrical height, will you be configuring the form tool for different gauges?
Or would a revolve cut library feature work better for your needs?
Your attach doesn't work... I don't know why!... I have SW 2014 sp2 64 bit
Probably because I'm on SW2015.
I've attached a screen shot of the revolve cut sketch.
It's dimmed to the bottom face so that the 0.4mm dimension is maintained independent of thickness, plus your 105° angle.
The 5mm dimension to the top face may interfere with using this as a library feature. A better dimension would be to the bottom edge with a value greater than the gauges you'll use, say 15mm or 20mm.
It's up to you as to whether the revolve cut method (as a library feature) would be better or worse than using a form tool.
The form tool method requires a form tool with a configuration for each gauge so when the stop face "hits", the 0.4mm dim is maintained across all gauges (or at least the gauges/materials you use).
You'll also need to remember to check the config of all of these since the 0.4 dim is "small" or not readily evident if its value is "close" to 0.4 but different.
You'll also need to remember to change the config of all of these if you change the gauge (which includes a material change since gauges aren't consistent across materials).
Plus you need to perform the cut operation to remove the torn material from each instance. You can use one cut to remove them, but that means the cut conditions have to miss other geometry, so multiple cuts may be required (& maintained/modified if subsequent features collide with them).
This is why I suggested the countersink (which is what you end up with) saved as a favorite or a library feature.
This assumes too, that you can readily add this feature into your part and still maintain your 0.4 dimension. I haven't tested this portion of my blather.
This is why I went with a revolve cut instead of the hole wizard since the wizard is top side. You could do a through hole with a far side csink, but either way, the wizard doesn't provide a means to directly maintain your 0.4 dim.
I hope this explains my first post better.
Thanks for all explains... I know that with a library feature is more simple and i have library features... The problem is:
I add PUNCH ID property to library feature and not appear in punch table. Work only for forming tools.
...of that i try to make a forming tool for that hole...
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